Altium Designer Documentation

Components

Modified by Tiffany Cullen on Sep 17, 2019

The Components panel provides direct access to all available server-based Managed Components and file-based Library Components in Altium Designer.

The panel sources components from a connected managed content server and any open or installed Library files. The panel offers full details of the selected component (Parameters, Models, Part Choices, Supplier data, etc.,), component comparison, and for Managed Components, a filter-based parametric search capability for specifying target component parameters.

The Components panel uses the basic search engine functionality and view that is applied in the Manufacturer Part Search panel. While the Manufacturer Part Search panel harnesses the Altium Parts Provider service and focuses on component manufacturer and supplier data searches, the Components panel is populated with ready-to-place components from your managed content server and file-based library sources.

Panel Access

To open the Components panel, select View » Panels » Components from the main menu or the Components option from the  button menu at the lower right of the main screen. Using a responsive design configuration, the panel layout will dynamically adapt between full screen (wide) mode and its narrow docked mode where the Categories/Filters options collapse to menus.

Select the File Libraries Preferences option from the library menu (top right) to manage access to file-based libraries through the Available File-based Libraries dialog.

The panel’s Categories pane (or drop-down menu in docked mode) lists any installed/open libraries and all available Managed Components under the All category entry. When the panel is in its wide mode, click the Categories heading (or the « icon) to collapse or expand the display of the column, and use the button (top right) to toggle the visibility of the component Details pane.

The Categories grouping for managed components is derived from the ComponentType parameters associated with each component. To specify or change a component's type on-the-fly, right click on its entry then select the Operations » Change Component Type option from the context menu to open the Component Type dialog.

Components that have been Acquired from the Manufacturer Part Search panel to your managed content server will be assigned a Component Type as part of the acquisition process.

When viewing managed components, the Filters pane is populated by selected filter options based on the current search and available parameters. Note that filters are only supported for server-based Managed Components. Use the Filter Search field to find a specific parameter filter, and in the panel's narrow/docked mode, click the  to pop out the Filters as a panel extension.

Components list

Within the component listing grid itself, the content that is included in the list is managed by:

  • Setting the component listing sort order – click a column heading to sort the component listing by that column data. Click the heading again to reverse the sort order.
  • Setting the order of the displayed columns – drag and drop a column heading to a new position.
  • Specifying which parameter columns are shown – right-click in a column header and choose Select Columns to open the Select Columns dialog then toggle a parameter column’s visibility and move its positional order with the Up/Down buttons.
  • Grouping the list by column data – right-click in a column header, select the Enable Columns Grouping option then drag a column header (e.g., Footprint) into the grouping space at the top of the list. The list entries will be collected under each unique parameter (e.g., type of footprint) from the specified grouping column.
    When using Grouping to collate components in the listing, there is a limit of 10,000 entries that can be accommodated.
  • Filtering the listing by a specific column entry – select  in a column header to display a list of its unique parameter entries then select an entry to constrain the listed components to those that include the specified parameter (e.g., a footprint type code). Select the All option to reset the filter. Select (Custom) to open the Filter Editor dialog in order to further refine the filtering in the selected column.

Displaying Columns

There are various manners in which you may display the contents within the Components panel. When right-clicking on the names of each column (Name, Description, Footprint) you may select from the following options, depending on how you wish to display the components:

  • Best Fit - merges the contents from the Name and Descriptions columns together so they are closely placed, with no excess room between each column.
  • Best Fit All Columns - merges the contents from all columns together so they are closely placed, with no excess room between each column.
  • Clear Sorting - used to undo the sorting of columns.
  • Enable Columns Grouping - allows you to drag column headers by a specific column, allowing you to change the order of the Name, Description, and Footprint columns.
  • Select Columns - opens the Select Columns dialog, which allows you to select other columns you would like visible in this section.

Component Search and Functions

Searching for components

To search for available components in the Components panel, enter a phrase in the Search field and/or use the panel's Categories and Filters selections to narrow the component listing to your specific needs. Filters are supported for Managed Components only, and as in the Manufacturer Part Search panel, the Components panel supports unit-aware (text to number) search filters. 

The Search function allows you to select then edit or add to an active Search string. Click the 'active' search string to enter it into the Search field. You can re-use or edit that search from the Search field

Placing Components

A selected component is placed on a schematic by dragging and dropping, by selecting Place from its right-click context menu, by using the button in the Details pane, or by using the Enter hotkey.

The parametric search capability of the panel's Filters relies on suitable component parameter data being passed from the server that hosts the Managed Components. As a result, the Filter functionality may be disabled when the software is connected to an older Altium server product. To enable the Filter for previous server versions, check the ComponentSearch.LegacyAFS.Filters option in the Advanced Settings dialog, which is accessed by clicking the Advanced buttion in the System – General page of the Preferences dialog.

Filtering

The panel Filters options can be tailored your needs by selecting particular parameter types as Favorites, which then shift to the top of the list for the current component Category. Hover to the right of a parameter filter’s name and click the  icon to set the filter as a Favorite. Favorite filter settings apply to and are saved for individual component Categories.

For Managed Components, the right-click menu offers options to edit the component through the Single Component Editor (Edit) and perform component management functions such as component creation and cloning, or editing the selected component's Part Choices and Type (Operations).

Additional information options in the component Details pane include: viewing a model image, viewing online datasheets (References) live Supplier information (Part Choices), seeing where the part has been used in Managed Projects (Where Used), and through the right-click menu, the ability to copy selected or all component parameter data (technical details) in a tab-delimited format, and resetting favorites.

Component Data Caching

When using the Components panel, the data for Managed Components are cached to the local machine from the Server. This provides an offline access mode for Managed Components when Altium Designer is not connected to the Server, and therefore allows normal component browsing and placement, etc. Note that Filters are not enabled in this mode.

This condition is indicated by the 'Offline mode – cached data is being used' warning text in the lower bar of the panel’s component list pane. The cache builds up component data over time and may be cleared (for all servers) using the Clear Cache option that is available under Known Servers in the Data Management – Servers page of the Preferences dialog. Component data caching is available in new Altium server products only.

Part Choices List

Edit the Part Choices List associated with a managed component by selecting the Operations » Create/Edit PCL option from the entry’s right click menu.

Use the following Edit Part Choices dialog’s button to open the Add Part Choices dialog, which will automatically search for part manufacturers by the selected component's Name parameter. Deselect the predefined search term to manually search for alternatives – functionally, the dialog is a modal version of the Manufacturer Part Search panel.

Part Choice entries in the list can be ranked by selecting an appropriate star icon level, where the list will automatically be reordered with the highest ranked manufacturer choice at the top.

A Part Choices List is carried with the component wherever its data is applied, such as in a Schematic design, BOM document, Output Report and so on.

Note: With the currently available Altium Server platform, Part Choice rankings are not saved.

File-based Libraries Search

The current listing of file-based Library components may be filtered by entering a search phase in the Components panel Search field. To access more advanced search capabilities for component Libraries, select the File-based Libraries Search option from the panel’s  menu, which opens the File-based Libraries Search dialog.

The search dialog offers flexible search options including query-based filter constraints, and the ability to search through all available file-based libraries or those within a specified path.

► See the File-based Libraries Search dialog page for more information

Compare Feature

The Compare feature allows you to compare parameters of two selected parts. This feature is accessed by selecting two components (parts) in the grid region with the  icon enabled (blue). The Selected Part Details region opens to the right of the grid region. The upper region (region 1 in the image below) displays an image, the name, description, and price of the selected parts side-by-side. Click the Datasheet button to open the manufacturer's datasheet (if available) for the associated component. Click the Place button to place the component in the design workspace. The component will appear floating in the workspace; click to place the component in the desired location. You can continue to place additional components or right-click or Esc to leave placement mode and return to the Components panel.

The lower region (region 2 in the image below) displays a side-by-side view of the components' parameters, with differences highlight in red text for easy comparison.

The Compare feature and functionality also is available in the Manufacturer Part Search panel.

Finding Similar Components

The Find Similar Components dialog provides the possibility to define search preferences based on the selected component.

The Find Similar Components dialog is used to define your search preferences based on the selected component. The final search results will depend on the selected component type, be it managed or unmanaged components, and your server connection status. For example, managed components will often display more parameters than a unmanaged component. To specifically gather components and parameters that are the same or different from the one selected, the drop-downs may be utilized to select SameAny, or Different choices. 

The dialog can be accessed by right-clicking on a listed component, then selecting Find Similar Components

Component Selection Dialogs

The search engine and view used in the Components panel is also applied in other Altium Designer applications where a component choice is made. The component search functionality is included in these (modal) dialogs, along with an OK confirmation button and minor variations in the available action commands. The dialog is typically called Component Search.

  • Properties panel – the Components search view is used when choosing an alternative component to replace an existing schematic component. Select a source library or managed content server (from the Source menu, under Properties in the Properties panel) and then select the Design ID button () to choose a replacement part in the Component Search dialog.
  • ActiveBOM document – the Components search view is used when changing a managed component to an alternative component. Right-click on a listed component item and select Change [component name] from the context menu to open the Component Search dialog.
  • Item Manager – the Components search view is used when manually choosing a managed component to replace the current component. Right-click on a listed component item and select Choose manually from the context menu to open the Component Search dialog.
  • Variant Management – the Components search view is used when choosing an alternate component project variation. Select an Alternate part as a Component Variation, then Choose in the Edit Component Variation dialog to open the Component Search dialog.
The legacy Libraries panel is disabled by default, but may be re-enabled in the software Preferences. To do so, click the button in the System – General page of the Preferences dialog then enable the Legacy.LibraryPanel option in the Advanced Settings dialog.
Found an issue with this document? Highlight the area, then use Ctrl+Enter to report it.

Contact Us

Contact our corporate or local offices directly.

You are reporting an issue with the following selected text
and/or image within the active document:
ALTIUM DESIGNER FREE TRIAL
Altium Designer Free Trial
Let’s get started. First off, are you or your organization already using Altium Designer?

If would like to speak with a representative, please contact your local Altium office.
Copyright © 2019 Altium Limited

In that case, why do you need an evaluation license?

If would like to speak with a representative, please contact your local Altium office.
Copyright © 2019 Altium Limited

Got it. You actually don’t need an evaluation license for that.

Click the button below to download the latest Altium Designer installer.

Download Altium Designer Installer

If would like to speak with a representative, please contact your local Altium office.
Copyright © 2019 Altium Limited

Please fill out the form below to get a quote for a new seat of Altium Designer.

By clicking “Get Your Free Trial”, you are agreeing to our Privacy Policy.
You may receive communications from Altium and can change your notification preferences at any time.

If you are on Altium Subscription, you don’t need an evaluation license.

If you are not an active Altium Subscription member, please fill out the form below to get your free trial.

By clicking “Get Your Free Trial”, you are agreeing to our Privacy Policy.
You may receive communications from Altium and can change your notification preferences at any time.

Why are you looking to evaluate Altium Designer?

If would like to speak with a representative, please contact your local Altium office.
Copyright © 2019 Altium Limited

You came to the right place! Please fill out the form below to get your free trial started.

By clicking “Get Your Free Trial”, you are agreeing to our Privacy Policy.
You may receive communications from Altium and can change your notification preferences at any time.

Sounds exciting! Did you know we offer special discounted student licenses? For more information, click here.

In the meantime, feel free to request a free trial by filling out the form below.

By clicking “Get Your Free Trial”, you are agreeing to our Privacy Policy.
You may receive communications from Altium and can change your notification preferences at any time.

Got it. You can download a free Altium Designer Viewer license which is valid for a 6 months.

Please fill out the form below to request one.

By clicking “Get Your Free Trial”, you are agreeing to our Privacy Policy.
You may receive communications from Altium and can change your notification preferences at any time.

That’s great! Making things is awesome. We have the perfect program for you.

Upverter is a free community-driven platform designed specifically to meet the needs of makers like you.

Click here to give it a try!

If would like to speak with a representative, please contact your local Altium office.
Copyright © 2019 Altium Limited

Got it. You can download a free Altium Designer Viewer license which is valid for a 6 months.

Please fill out the form below to request one.

By clicking “Get Your Free Trial”, you are agreeing to our Privacy Policy.
You may receive communications from Altium and can change your notification preferences at any time.