Altium Designer Documentation

Bending Line

Modified by Susan Riege on Apr 10, 2021
All Contents

Parent page: PCB Objects

A board with multiple Bending Lines (shown as orange dashed lines) each defines the position and properties of a physical bend in a flexible region of the board. The orange band denotes the area that curves.

Summary

A Bending Line is a PCB object that defines the properties of a bend in a flexible region of a printed circuit board. When a Bending Line is placed across a Board Region it defines where and how that region should bend, including the bend angle and the radius of the bend. When the PCB is displayed in 3D Layout Mode the bends can be applied, providing a real-world view of the behavior of the rigid-flex design as it folds and unfolds.

A Bending Line is placed over the flexible region and configured so the board can fold 180 degrees.

Availability

Bending Lines are available in the PCB Editor when the View mode is set to Board Planning Mode (View » Board Planning Mode or press the 1 shortcut).

Placement

To place a Bending Line:

  1. Select View » Board Planning Mode (or press the 1 shortcut) to enter Board Planning Mode.
  2. Select Place » Define Bending Line from the main menus, or click the  button on the Active Bar.
  3. A Bending Line is placed over the required Board Region, it does not attach to it (Bending Lines are associated with one or more Board Regions by the Stack Regions property). Click near the edge of the Board Region to define the Bending Line start location.
  4. Move the cursor to the required end location and click to place the Bending Line. Note that at least one end of the Bending Line must touch or cross the boundary of the Board Region that it applies to.
  5. You remain in Bending Line placement mode, ready to place another Bending Line if required. If not, right-click or press Esc to exit Bending Line placement mode.
  6. Select the Bending Line and in the Properties panel, configure the:
    1. Radius
    2. Bend Angle
    3. Stack Regions (only required if there are multiple Board Regions under the Bending Line - enable only those regions that this bend applies to)
    4. Fold Index (only required if you need to control the order that multiple bends are applied to your board, the bend with the lowest Fold Index value is applied first)

During placement of a Bending Line, the cursor is constrained by the cursor snap settings, which include: the current Snap Grid, the available Objects for Snapping, the presence of Workspace Guides, and the Axes Snapping settings - use these features to help achieve the required shape.

Learn more about Understanding the Snap Behavior.

Graphical Editing

A Bending Line can be graphically edited by manipulating the vertices at each end of the line, using a select and drag method.

Moving a Bending Line

  1. Select View » Board Planning Mode (or press the 1 shortcut) to enter Board Planning Mode.
  2. Click and hold on the vertex at either end of the Bending Line, then drag that vertex to the required location and release the mouse button. The cursor will be constrained to the current cursor snap settings, press Ctrl+E to change the settings as you work.
  3. The bend location will be redefined by the Bending Line's new position.

Select and drag a Bending Line vertex to change the Bending Line's position on the board - the cursor will be constrained by the current cursor snap settings.

Deleting a Bending Line

  1. Select View » Board Planning Mode (or press the 1 shortcut) to enter Board Planning Mode.
  2. Click and hold on one of its vertices to select the Bending Line, then press the Delete key.

Non-Graphical Editing

The following methods of non-graphical editing are available:

Editing Via the Properties Panel

Properties page: Bending Line Properties

This method of editing uses the Properties panel to modify the properties of a Bending Line object.

The Bending Line mode of the Properties panel

After placement, the Bending Line mode of the Properties panel can be accessed in one of the following ways:

  • If the Properties panel is already active, by selecting the Bending Line object.
  • After selecting the Bending Line object, select the Properties panel from the Panels button at the bottom right of the design space or select View » Panels » Properties from the main menu.

If the Double Click Runs Interactive Properties option is disabled (default) on the PCB Editor - General page of the Preferences dialog, when the primitive is double-clicked or you right-click on a selected primitive then choose Properties, the dialog will open. When the Double Click Runs Interactive Properties option is enabled, the Properties panel will open.

While the options are the same in the dialog and the panel, the order and placement of the options may differ slightly.

Press Ctrl+Q to toggle the units of measurement currently used in the panel between metric (mm) and imperial (mil). This only affects the display of measurements in the panel, it does not change the measurement unit specified for the board - this is configured in the Units setting in the Properties panel when there are no objects selected in the editing design space.

 

Found an issue with this document? Highlight the area, then use Ctrl+Enter to report it.

Contact Us

Contact our corporate or local offices directly.

We're sorry to hear the article wasn't helpful to you.
Could you take a moment to tell us why?
You are reporting an issue with the following selected text
and/or image within the active document:
ALTIUM DESIGNER FREE TRIAL
Altium Designer Free Trial
Let’s get started. First off, are you or your organization already using Altium Designer?

If would like to speak with a representative, please contact your local Altium office.
Copyright © 2019 Altium Limited

In that case, why do you need an evaluation license?

If would like to speak with a representative, please contact your local Altium office.
Copyright © 2019 Altium Limited

Got it. You actually don’t need an evaluation license for that.

Click the button below to download the latest Altium Designer installer.

Download Altium Designer Installer

If would like to speak with a representative, please contact your local Altium office.
Copyright © 2019 Altium Limited

Please fill out the form below to get a quote for a new seat of Altium Designer.

By clicking “Get Your Free Trial”, you are agreeing to our Privacy Policy.
You may receive communications from Altium and can change your notification preferences at any time.

If you are on Altium Subscription, you don’t need an evaluation license.

If you are not an active Altium Subscription member, please fill out the form below to get your free trial.

By clicking “Get Your Free Trial”, you are agreeing to our Privacy Policy.
You may receive communications from Altium and can change your notification preferences at any time.

Why are you looking to evaluate Altium Designer?

If would like to speak with a representative, please contact your local Altium office.
Copyright © 2019 Altium Limited

You came to the right place! Please fill out the form below to get your free trial started.

By clicking “Get Your Free Trial”, you are agreeing to our Privacy Policy.
You may receive communications from Altium and can change your notification preferences at any time.

Great News!

Valid students can get their very own 6-month Altium Designer Student License for FREE! Just fill out the form below to request your Student License today.

By clicking “Get Your Free Trial”, you are agreeing to our Privacy Policy.
You may receive communications from Altium and can change your notification preferences at any time.

Got it. You can download a free Altium Designer Viewer license which is valid for a 6 months.

Please fill out the form below to request one.

By clicking “Get Your Free Trial”, you are agreeing to our Privacy Policy.
You may receive communications from Altium and can change your notification preferences at any time.

That’s great! Making things is awesome. We have the perfect program for you.

Upverter is a free community-driven platform designed specifically to meet the needs of makers like you.

Click here to give it a try!

If would like to speak with a representative, please contact your local Altium office.
Copyright © 2019 Altium Limited

Got it. You can download a free Altium Designer Viewer license which is valid for a 6 months.

Please fill out the form below to request one.

By clicking “Get Your Free Trial”, you are agreeing to our Privacy Policy.
You may receive communications from Altium and can change your notification preferences at any time.