Altium NEXUS Documentation

Part Properties

Modified by Tania Mashkoory on Feb 11, 2021
All Contents

Parent page: Part

Schematic Editor object properties are definable options that specify the visual style, content, and behavior of the placed object. The property settings for each type of object are defined in two different ways:

  • Pre-placement settings – most Part object properties, or those that can logically be pre-defined, are available as editable default settings on the Schematic - Defaults page of the Preferences dialog (access from the  button at the top-right of the design space). Select the object in the Primitive List to reveal its options on the right.

  • Post-placement settings – all Part object properties are available for editing in the Properties panel when a placed Part is selected in the design space.

 

Part Properties

General

  • Designator - enter the designator. Toggle  or  to show/hide the designator. Use the  icon to lock/unlock the designator. 
  • Comment - enter the name. Toggle  or  to show/hide the name. Use the  icon to lock/unlock the name. 
  • Part <x> of Parts  - displays the number of the selected part and the total number of parts. Use the drop-down to select the number of the associated part then enter the total number of parts. Click  to lock/unlock the fields.
  • Description - the component/part description.
  • Type - Select one of the following component types for the component footprint here. The available types are:
    • Standard - components that possess standard electrical properties, are always synchronized between the schematic and PCB (the footprint, pins/pads and net assignments must all match), and are included in the BOM. An example is a standard electrical component, such as a resistor.
    • Mechanical - components that do not have electrical properties, are not synchronized (you must manually place them in both editors), and are included in the BOM. An example is a heatsink.
    • Graphical - components that do not have electrical properties, are not synchronized (you must manually place them in both editors), and are not included in the BOM. An example is a company logo.
    • Net Tie (In BOM) - components that are used to short two or more different nets together, are always synchronized between the schematic and PCB (the footprint, pins/pads and net assignments must all match), and are included in the BOM. They differ from a Standard component in that connectivity created by copper within the footprint is not checked; it is this copper that allows the nets to be shorted. Note: enable the Verify Shorting Copper option in the Design Rule Checker dialog to verify that there is no unconnected copper within the component.
    • Net Tie (No BOM) - components that are used to short two or more different nets together, are always synchronized between the schematic and PCB (the footprint, pins/pads and net assignments must all match), and are not included in the BOM. They differ from a Standard component in that connectivity created by copper within the footprint is not checked; it is this copper that allows the nets to be shorted. Note: enable the Verify Shorting Copper option in the Design Rule Checker dialog to verify that there is no unconnected copper in the component.
    • Standard (No BOM) - components that possess standard electrical properties, are always synchronized between the schematic and PCB (the footprint, pins/pads and net assignments must all match), and are not included in the BOM. An example is a testpoint component that you want to exclude from the BOM.
    • Jumper - components that are used to include wire links in a PCB design, for example, on a single-sided PCB that cannot be fully routed on one layer. For this component type, the component footprint and pins are synchronized between the schematic and PCB but the net assignments are not, and the component is included in the BOM. As well as selecting this option at the component level, both of the pads in the component must have their JumperID set to the same non-zero value. Jumper type components do not need to be wired on the schematic; they only need to be included on the schematic if they are required in the BOM. If they are not required in the BOM, they can be placed directly in the PCB where the Component Type is set, the JumperIDs are set, and the Nets manually assigned for the pads. 
  • Design Item ID - this field lists the name of the component selected. Click  to open the Replace Component (Managed) dialog or Replace Component (File-based) dialog, depending on whether the component is managed or non-managed. This dialog grants access to full details of the selected component (Parameters, Models, Part Choices, Supplier data, etc.,), component comparison, and the ability to replace the current component with another, among other possibilities. If another component is selected as a replacement, this field will then display the full Design Item ID for the newly selected component. Click the Validate button to see information regarding where the component resides. If it is non-managed, the file path in which it is saved on your computer will appear. If it is managed, the information will indicate that the component was simply found.
  • Source - displays the name of the source library of the component. Click  to search for and select the desired library.
  • Revision State - this field displays the revision state of the part. Select the   icon to update the part's revision state. The SPN (Supplier Part Number) contains the following information:
    • Colored tile banner showing the supplier name and price. The color reflects the risk associated with choosing that supplier. The risk can change at any time based on the availability and price data received from the Altium Parts Provider.
      • Green = Best
      • Orange = Acceptable
      • Red = Risky
    • Supplier part number (linked to the part on the Supplier's website)
    • Last updated icon with details displayed in the tooltip, color indicates:
      • White/Gray = Default, updated less than one week ago
      • Orange = 1 week < last update < month ago
      • Red = last update > 1 month ago
    • Country code for the Supplier location (ISO alpha 2); colored red if unknown.
    • Part source, details displayed in the tooltip.
    • Stock quantity; red if no stock available.
    • Unit price, red if no price available. Unit price includes currency icon, currency is determined by the location of the supplier.
    • Available price breaks, with Minimum Order Quantities.
If a component used in a design (or managed schematic sheet) has been deleted, this will be indicated at the bottom of the General tab in the Properties panel by the associated  'Deleted' icon. 

Location 

  • (X/Y)  
    • X (first field) - the current X (horizontal) coordinate of the reference point of the object, relative to the current workspace origin. Edit to change the X position of the object. The value can be entered in either metric or imperial; include the units when entering a value whose units are not the current default. 
    • Y (second field) - The current Y (vertical) coordinate of the reference point of the object, relative to the current origin. Edit to change the Y position of the object. The value can be entered in either metric or imperial; include the units when entering a value whose units are not the current default. 
  • Rotation - use the drop-down to select the rotation. Choices are 0 Degrees90 Degrees180 Degrees, and 270 Degrees.

Parameters

  • Grid - lists the Name and Value of the parameters associated with the currently selected component. Use  to lock/unlock a listed parameter. Parameter values can be manually entered, or selected from a drop-down menu list that offers values sourced from all the available components of that type.
  • Favorites - parameters marked as Favorites will be shown in the Parameters list, while those not marked will be hidden. Hover to the right of a parameter filter’s name and click the  icon to set the filter as a Favorite. To remove a parameter as a Favorite, click the icon again. To see all hidden parameters, click the Show More link at the bottom of the list. 
  • Font - click on the displayed font to change the font style.
  • Other - click to open a drop-down to change additional options:
    • Show Parameter Name - enable to show the parameter name.
    • Allow Synchronization with Database - enable to synchronize with the database. This option is used to control if the comment can be updated. By default, these options are enabled to always allow synchronization with the source library/database. You may disable this option to prevent that comment from being included in an update process.
    • (X/Y) - enter the X and Y coordinates.
    • Rotation - use the drop-down to select the rotation. Choices are: 90°180°, and 270°.
    • Autoposition - check to enable auto-positioning, meaning that the text will remain in the chosen position as the component is moved and rotated.
  • Add - click to add a parameter, such as a footprint, model, or rule, among others. Use the bin  to delete a selected entry from the grid. Use the pencil icon to edit the parameter via the parameter's respective dialog.

Graphical

  • Mode - use the drop-down to select the desired mode. If no modes other than Normal are available, this drop-down will be grayed-out.
  • Mirrored - enable to mirror the part.
  • Local Colors - check to enable the following options:
    • Fills - click on the color box to access a drop-down from which you can select the default color.
    • Lines - click on the color box to access a drop-down from which you can select the default color.
    • Pins - click on the color box to access a drop-down from which you can select the default color.

Part Choices

  • Part Name - click to be lead to further information about the part, provided directly from the supplier.
  • Datasheet - click this button to be lead to the product's latest information, directly from the supplier's website.
  • SPN(s) - an SPN (Supplier Part Number) contains the following information:
    • Colored tile banner showing the supplier name and price. The color reflects the risk associated with choosing that supplier. The risk can change at any time based on the availability and price data received from the Altium Parts Provider.
      • Green = Best
      • Orange = Acceptable
      • Red = Risky
    • Supplier part number (linked to the part on the Supplier's website)
    • Last updated icon with details displayed in the tooltip, color indicates:
      • White/Gray = Default, updated less than one week ago
      • Orange = 1 week < last update < month ago
      • Red = last update > 1 month ago
    • Country code for the Supplier location (ISO alpha 2); colored red if unknown.
    • Part source, details displayed in the tooltip.
    • Stock quantity; red if no stock available.
    • Unit price, red if no price available. Unit price includes currency icon, currency is determined by the location of the supplier.
    • Available price breaks, with Minimum Order Quantities.
If no part choices are available, a button that will open the Edit Supplier Links dialog will be made available, which you may use to add supplier links for a component.

Pins 

This region lists the Pins and Names for all the pins of the selected component. Use  or  to show/hide the pin. Use  to lock/unlock the pins.

  • Add - click to add a pin. Use the trash can   to delete a selected entry from the table. Use the pencil to open the Component Pin Editor dialog.

Click the Pins button, located in the bottom left corner of the Component dialog, to open the Component Pin Editor dialog, from where you may view all pins for either the component in the active schematic library document or a placed component (or part thereof) in the schematic editor.

Generic Components

When Altium NEXUS is connected to an Altium 365 Workspace, the available Generic Components can be accessed from the Components panel where they are displayed when the All option is selected in the Categories pane – or from the top drop-down menu when the panel is in its narrow mode. Click on the  button within a Generic Component tile to attach the component to the cursor for placement in the active schematic. Selecting the tile itself will open that component type category in the Components panel.

Note the Generic Components feature is not available with a Standard Subscription Plan. 

Generic Component Properties

General 

  • Designator - enter the designator. Toggle  or  to show/hide the designator. Use the  icon to lock/unlock the designator. 
  • Comment - enter the name. Toggle  or  to show/hide the name. 
  • Description - the generic component/part description.
    • Replace - select the Replace button when a design has progressed to the point where a Generic Component can be replaced with a specific physical component using the Replace Component dialog.

Location

  • (X/Y)  
    • X (first field) - the current X (horizontal) coordinate of the reference point of the object, relative to the current design space origin. Edit to change the X position of the object. The value can be entered in either metric or imperial; include the units when entering a value whose units are not the current default. 
    • Y (second field) - The current Y (vertical) coordinate of the reference point of the object, relative to the current origin. Edit to change the Y position of the object. The value can be entered in either metric or imperial; include the units when entering a value whose units are not the current default. 
  • Rotation - use the drop-down to select the rotation. Choices are 0 Degrees90 Degrees180 Degrees, and 270 Degrees.

Parameters

  • Grid - lists the Name and Value of the parameters associated with the currently selected component. Use the  to lock/unlock a listed parameter. Parameter values can be manually entered, or selected from a drop-down menu list that offers values sourced from all the available components of that type.
  • Favorites - parameters marked as Favorites will be shown in the Parameters list, while those not marked will be hidden. Hover to the right of a parameter filter’s name and click the  icon to set the filter as a Favorite. To remove a parameter as a Favorite, click the icon again. To see all hidden parameters, click the Show More link at the bottom of the list. 

  • Font - click on the displayed font to change the font style.
  • Other - click to open a drop-down to change additional options:
    • Show Parameter Name - enable to show the parameter name.
    • Allow Synchronization with Database - enable to synchronize with the database. This option is used to control if the comment can be updated. By default, these options are enabled to always allow synchronization with the source library/database. You may disable this option to prevent that comment from being included in an update process.
    • (X/Y) - enter the X and Y coordinates.
    • Rotation - use the drop-down to select the rotation. Choices are 90°180°, and 270°.
    • Autoposition - check to enable auto-positioning, meaning that the text will remain in the chosen position as the component is moved and rotated.
Found an issue with this document? Highlight the area, then use Ctrl+Enter to report it.

お問合せ

お近くの営業所にお問合せください。

We're sorry to hear the article wasn't helpful to you.
Could you take a moment to tell us why?
You are reporting an issue with the following selected text
and/or image within the active document:
Altium Designer 無償評価版
Altium Designer 無償評価版
Altium Designerを使用していますか?

弊社の営業担当より詳細情報をご案内しますので、アルティウムジャパン までお問い合わせください。.
Copyright © 2019 Altium Limited

評価版ライセンスが必要な理由を下記から選択してください。

弊社の営業担当より詳細情報をご案内しますので、アルティウムジャパン までお問い合わせください。.
Copyright © 2019 Altium Limited

その場合、評価版ライセンスは不要です。

ボタンをクリックして、最新のAltium Designerインストーラをダウンロードしてください。

Altium Designerインストーラをダウンロードする

弊社の営業担当より詳細情報をご案内しますので、アルティウムジャパン までお問い合わせください。.
Copyright © 2019 Altium Limited

Altium Designerの新規ライセンスのお見積もりをご希望の場合、下記のフォームに入力してください。

プライバシーポリシーに同意の上、[ダウンロード]をクリックしてください。ご登録いただきましたメールアドレスにメールマガジンが送信されます。メール配信の停止は、メール内の​通知設定​​でお手続きいただけます。

Altium Designerサブスクリプションをご利用中の場合、評価版ライセンスは不要です。

お客様がAltium Designerサブスクリプションの有効なメンバーではない場合、下記のフォームに入力して無償評価版をダウンロードしてください。

プライバシーポリシーに同意の上、[ダウンロード]をクリックしてください。ご登録いただきましたメールアドレスにメールマガジンが送信されます。メール配信の停止は、メール内の​通知設定​​でお手続きいただけます。

Altium Designerを評価する理由を下記から選択してください。

弊社の営業担当より詳細情報をご案内しますので、アルティウムジャパン までお問い合わせください。.
Copyright © 2019 Altium Limited

無償評価版を使用するには、下記のフォームに入力してください。

プライバシーポリシーに同意の上、[ダウンロード]をクリックしてください。ご登録いただきましたメールアドレスにメールマガジンが送信されます。メール配信の停止は、メール内の​通知設定​​でお手続きいただけます。

Great News!

Valid students can get their very own 6-month Altium Designer Student License for FREE! Just fill out the form below to request your Student License today.

プライバシーポリシーに同意の上、[ダウンロード]をクリックしてください。ご登録いただきましたメールアドレスにメールマガジンが送信されます。メール配信の停止は、メール内の​通知設定​​でお手続きいただけます。

その場合、Altium Designerビューワーの無償ライセンス(有効期間6か月)をダウンロードできます。

下記のフォームに入力してライセンスをリクエストしてください。

プライバシーポリシーに同意の上、[ダウンロード]をクリックしてください。ご登録いただきましたメールアドレスにメールマガジンが送信されます。メール配信の停止は、メール内の​通知設定​​でお手続きいただけます。

素晴らしいですね。アルティウムではモノづくりに最適なプログラムを提供しています。

Upverterは、コミュニティ主導型の無償プラットフォームで、お客様のような作り手の要求に合わせて設計されています。

試してみる場合、こちらをクリック してください。

弊社の営業担当より詳細情報をご案内しますので、アルティウムジャパン までお問い合わせください。.
Copyright © 2019 Altium Limited

その場合、Altium Designerビューワーの無償ライセンス(有効期間6か月)をダウンロードできます。

下記のフォームに入力してライセンスをリクエストしてください。

プライバシーポリシーに同意の上、[ダウンロード]をクリックしてください。ご登録いただきましたメールアドレスにメールマガジンが送信されます。メール配信の停止は、メール内の​通知設定​​でお手続きいただけます。