Altium NEXUS Documentation

Working with Mechanical Layers

Modified by Susan Riege on Mar 20, 2020
このページは、サポート対象外となったAltium Vaultについて紹介しています。Altium Vaultとそのコンポーネント管理機能は Altium Concord Proに移行しました。

Even the simplest board needs design detail beyond the tracks and pads that implement the circuit. It might be the board dimensions or the fabrication detail, it might be the component courtyards, or it might be the 3D component models.

In Altium NEXUS, this type of additional information is detailed on Mechanical Layers. These layers can be included in printouts or in fabrication outputs, as required.

Added Mechanical Layers to the Design

Mechanical layers are added, edited and removed in the View Configuration panel. Their display state is also configured in the panel. Use the  button at the bottom-right of the workspace, or press the L shortcut key, to display the panel.

  • Right-click anywhere in the Layers region of the panel to display the context menu, where you can add additional mechanical layers.
  • There is no limit to the number of mechanical layers that can be added.
  • Double-click on a mechanical layer to enter the Layer Name, define a Layer Number, and assign a Layer Type.
  • When a mechanical layer has one of the pre-defined Layer Types assigned, the layer number is no longer displayed in the View Configuration panel.

Even though older versions of Altium's PCB design software are limited to 32 mechanical layers, newer PCB files that contain more than 32 layers can be safely opened and edited in an older version.

Layer Types

There are several layer types that can be specified when adding a mechanical layer. Right-click in the Mechanical Layers region of the View Configuration panel then select Add Mechanical Layer from the context menu. In the Edit Layer dialog that opens, use the Layer Type drop-down to select the required layer type. Available layer types are defined below.

       

  • 3D Body - used for 3D body placement.
  • Assembly - used to hold the assembly data.
  • Assembly Notes - used to detail the component load order and/or important assembly instructions.
  • Board - used for the overall board size.  
  • Coating - used to coat and protect the board.
  • Component Center - used for component placement.
  • Courtyard - used to define the space in which no other component should be placed.
  • Designator -used to place designators.
  • Dimensions - used to specify the outline of the board.
  • Fab Notes - used to detail important fabrication notes.
  • Glue Points - used to place glue points.
  • Gold Plating - used to provide a corrosion-resistant, electrically conductive layer on copper.
  • Route Tool Path - used to indicate the layer that contains the mechanical routing information. Note that a user-defined name is not permitted when using this layer type.
  • Sheet - used as a display feature and is designed to work with objects placed on a mechanical layer (such as dimensions, notes, and title blocks). The properties of a Sheet can be configured in the Properties panel in Board mode including the X/Y Axes, Width, and Height. You can customize all of the size values or enable the Get Size From Sheet Layer option to show the default size values from the Sheet.
  • V Cut - used to split circuit boards by cutting a "v" groove on the top and bottom of a circuit board while leaving a minimum amount of material in place to hold the boards together.
  • Value - contains the specific values for each component on the board.

Displaying Mechanical Layers

  • Click the visibility icon (  ) next to the layer's name to toggle the display of that mechanical layer on or off, or select the layer name and press the Spacebar (this toggles the display of both layers in a Component Layer Pair).
  • Mechanical layers have an additional display feature, they can set to remain visible when the display is in Single Layer Mode. Hold Ctrl as you click on the visibility icon of a mechanical layer to enable the Display in Single Layer Mode feature. The visibility icon changes to indicate that this layer has this feature enabled (  ), Ctrl+click a second time to disable this mode.

Single Layer Mode is a handy display control feature, where all other layers are hidden apart from the active (current) layer. Press Shift+S to cycle through the enabled Single Layer Modes, then back to the previous layer display state. When the display is in single layer mode the non-active layers can be: completely hidden; set to gray; or set to monochrome. The Available Single Layer Modes options are configured in the PCB Editor - Board Insight Display page of the Preferences dialog.

Mechanical Layers and Component Layer Pairs

In some situations the extra detail included on a mechanical layer is only needed once, for example assembly notes that detail the component load order and important assembly instructions. In this situation a standard mechanical layer is added, named, and where possible, has its Layer Type assigned (more on this below).

If the extra detail is required for a component, for example component courtyard outlines, there needs to be two mechanical layers assigned, one layer holding the courtyard detail when the component is placed on the Top side of the board, the other mechanical layer holding that same courtyard detail if the component is flipped to the bottom side of the board.

In this situation a pair of mechanical layers is added, as a Component Layer Pair. When mechanical layers are added as a Component Layer Pair, they are displayed in the Component Layer Pairs section of the View Configuration panel, as shown below.

A number of user-defined Component Layer Pairs have been added.
Note the last pair, it does not have a Layer Type assigned, so the layer numbers are displayed.

  • Any number of Component Layer Pairs can be defined.
  • Layer Pairs can also have a Layer Type assigned, when this is assigned the mechanical layer numbers are no longer displayed in the panel.
  • In the workspace, the two layers in the pair are displayed on separate layer tabs, using the naming Top <LayerPairName> and Bottom <LayerPairName> ( show me ).
  • In the PCB library editor, additional design objects required in a component footprint are placed on the top pair layer. When the component is flipped to the bottom side of the board, the contents of the top layer in the pair are automatically mirrored onto the bottom layer in the pair.
  • If a Component Layer Pair defined in the PCB library has the Layer Type assigned, that Layer Pair is automatically created on the PCB when a component using those layers is placed. If the PCB already has a Component Layer Pair of that Layer Type, the contents of those layers are mapped accordingly.
  • For Component Layer Pair defined in the PCB library that do not have a Layer Type assigned in the library, individual mechanical layers are created on the PCB. In this situation, pre-define the Component Layer Pair in the PCB using the same layer numbers before placing the component, as the software will fall back to matching by Layer Number if it is unable to match by Layer Type.

Support for creating Component Layer Pairs in the PCB library editor was added in Altium NEXUS version 2.

The Advantage of Assigning a Layer Type

A common approach to managing mechanical layer usage is to assign a dedicated layer number for each required mechanical layer function. This approach requires all designers to adhere to the same layer assignment & numbering scheme. It can also create difficulties when components are obtained from other sources that do not follow the same assignment & numbering scheme. If a different scheme has been used, the design objects must be moved from their current mechanical layer, to the mechanical layer assigned for that function.

This issue is resolved with the introduction of the Layer Type property. When a component is placed from a library into the PCB editor, or copied from one library to another, or created by the IPC Footprint Wizard, existing Layer Type assignments are automatically matched, regardless of the mechanical layer number(s) assigned to those Layer Types. The objects are relocated on the correct layer(s), according to their Layer Type. If the software is unable to match by Layer Type, it will fall back to matching by Layer Number.

For both individual mechanical layers and Component Layer Pairs, you can select a Layer Type from a pre-defined list of types. The images below show the full list of available Layer Types.

  Select the Layer Type from the pre-defined list of Types, individual mechanical layers are shown on the left, Component Layer Pairs are shown on the right.

Layer Types were added in Altium NEXUS version 2.

Naming Layers with a Layer Type Assigned

When a Layer Type is assigned, the layer automatically has its Layer Name property changed to be the same as the Layer Type. This can be overridden if required, by typing in a user-defined name. When a layer has a user-defined name and a Layer Type assigned then both are displayed, with the Layer Type shown in brackets, as shown below for the Layer Pair GP (Gold Plating).

If an individual mechanical layer or a Component Layer Pair have a Layer Type assigned then the mechanical layer number is no longer displayed, reflecting that the software will manage and map the layer by Type instead of number.

The Route Tool Path Layer Type

There is one exception to the naming behavior just described when a Layer Type is assigned, a user-defined name is not permitted when the Layer Type is set to Route Tool Path. The reason for this is that older versions of the software use the name of the Route Tool Path layer to identify the layer that contains the route information (also referred to as rout information). Fixing the naming of this layer insures that the design will continue to function correctly in an older version.

The Route Tool Path Layer Type is used to indicate the layer that contains the mechanical routing information. A typical approach to using this layer is to place tracks and arcs around the outer edge of the board shape to define the machining path and width. Solid sections are left to hold the board within the panel, and then a series of small holes is placed across each solid section to create perforations (often referred to as mouse-bites), allowing the board to be snapped out of the panel once the assembly process is complete.

When the board is displayed in 3D mode, objects detected on the Route Tool Path layer are displayed as a routed slot in the board, as shown below.

Objects detected on the Route Tool Path layer are used to visualize the routed board, in 3D display mode.

Use the Line/Arc Primitives from Board Shape dialog to trace the outside of the board shape with tracks and arcs. Enable the Route Tool Outline option in the dialog to have the objects placed outside the board shape, rather than centered along its edge. Some designers prefer to add the fabrication information when they use the Embedded Board Array feature to create an assembly panel, rather than including this detail in the actual board file.

Transitioning from Numbered Mechanical Layers to Layer Types

Where possible, it is recommended to edit the source library and assign Layer Types. When a component footprint is placed (or copied) from a library, mechanical layers and Component Layer Pairs of those Layer Types are automatically created in the target board (or library) if they do not exist. If those Layer Types already exist in the target board (or library), the layer contents are automatically mapped to the correct layer.

User layers with a Layer Type assigned are automatically created or mapped, when the component is placed onto a board (hover the cursor over to show the component on the board).

Including Mechanical Layers in Output

Mechanical layers are used for a broad variety of tasks, detailing information used during: board design, fabrication, assembly, and product documentation. To support all of these requirements, mechanical layers can be excluded or included in all forms of layer-based output generation, including printing and output file generation.

Printed Output

Any of the layers that are present in the design can be included in the specification of a PCB Printout, including mechanical layers. Printouts are configured by adding the required layers and setting their order, in the PCB Printouts dialog.

Highly detailed fabrication and assembly drawings can be created by placing objects on mechanical layers.

Learn more about Configuring PCB Printouts

The software also includes an advanced, yet flexible graphical editing environment for creating board design production documents, called Draftsman. Complete with a dedicated set of drawing tools, the Draftsman drawing system provides an interactive approach to bringing together fabrication and assembly drawings with custom templates, annotations, dimensions, callouts, and notes.

Learn more about Draftsman

Generated Outputs

All fabrication-type outputs, such as Gerber and ODB++, allow mechanical layers to be included as an output Layer to Plot, or, to be added as detail to every layer being plotted.

Mechanical layers can be plotted, or they can be added to all plots if required.

Learn More about Outputs

Found an issue with this document? Highlight the area, then use Ctrl+Enter to report it.

お問合せ

お近くの営業所にお問合せください。

We're sorry to hear the article wasn't helpful to you.
Could you take a moment to tell us why?
You are reporting an issue with the following selected text
and/or image within the active document:
Altium Designer 無償評価版
Altium Designer 無償評価版
Altium Designerを使用していますか?

弊社の営業担当より詳細情報をご案内しますので、アルティウムジャパン までお問い合わせください。.
Copyright © 2019 Altium Limited

評価版ライセンスが必要な理由を下記から選択してください。

弊社の営業担当より詳細情報をご案内しますので、アルティウムジャパン までお問い合わせください。.
Copyright © 2019 Altium Limited

その場合、評価版ライセンスは不要です。

ボタンをクリックして、最新のAltium Designerインストーラをダウンロードしてください。

Altium Designerインストーラをダウンロードする

弊社の営業担当より詳細情報をご案内しますので、アルティウムジャパン までお問い合わせください。.
Copyright © 2019 Altium Limited

Altium Designerの新規ライセンスのお見積もりをご希望の場合、下記のフォームに入力してください。

プライバシーポリシーに同意の上、[ダウンロード]をクリックしてください。ご登録いただきましたメールアドレスにメールマガジンが送信されます。メール配信の停止は、メール内の​通知設定​​でお手続きいただけます。

Altium Designerサブスクリプションをご利用中の場合、評価版ライセンスは不要です。

お客様がAltium Designerサブスクリプションの有効なメンバーではない場合、下記のフォームに入力して無償評価版をダウンロードしてください。

プライバシーポリシーに同意の上、[ダウンロード]をクリックしてください。ご登録いただきましたメールアドレスにメールマガジンが送信されます。メール配信の停止は、メール内の​通知設定​​でお手続きいただけます。

Altium Designerを評価する理由を下記から選択してください。

弊社の営業担当より詳細情報をご案内しますので、アルティウムジャパン までお問い合わせください。.
Copyright © 2019 Altium Limited

無償評価版を使用するには、下記のフォームに入力してください。

プライバシーポリシーに同意の上、[ダウンロード]をクリックしてください。ご登録いただきましたメールアドレスにメールマガジンが送信されます。メール配信の停止は、メール内の​通知設定​​でお手続きいただけます。

Great News!

Valid students can get their very own 6-month Altium Designer Student License for FREE! Just fill out the form below to request your Student License today.

プライバシーポリシーに同意の上、[ダウンロード]をクリックしてください。ご登録いただきましたメールアドレスにメールマガジンが送信されます。メール配信の停止は、メール内の​通知設定​​でお手続きいただけます。

その場合、Altium Designerビューワーの無償ライセンス(有効期間6か月)をダウンロードできます。

下記のフォームに入力してライセンスをリクエストしてください。

プライバシーポリシーに同意の上、[ダウンロード]をクリックしてください。ご登録いただきましたメールアドレスにメールマガジンが送信されます。メール配信の停止は、メール内の​通知設定​​でお手続きいただけます。

素晴らしいですね。アルティウムではモノづくりに最適なプログラムを提供しています。

Upverterは、コミュニティ主導型の無償プラットフォームで、お客様のような作り手の要求に合わせて設計されています。

試してみる場合、こちらをクリック してください。

弊社の営業担当より詳細情報をご案内しますので、アルティウムジャパン までお問い合わせください。.
Copyright © 2019 Altium Limited

その場合、Altium Designerビューワーの無償ライセンス(有効期間6か月)をダウンロードできます。

下記のフォームに入力してライセンスをリクエストしてください。

プライバシーポリシーに同意の上、[ダウンロード]をクリックしてください。ご登録いただきましたメールアドレスにメールマガジンが送信されます。メール配信の停止は、メール内の​通知設定​​でお手続きいただけます。