PCB Editor - Interactive Routing

Modified by Susan Riege on Sep 15, 2017
このページは、サポート対象外となったAltium Vaultについて紹介しています。Altium Vaultとそのコンポーネント管理機能は Altium Concord Proに移行しました。

Parent page: PCB Preferences


The PCB Editor - Interactive Routing page of the Preferences dialog

Summary

The PCB Editor – Interactive Routing page of the Preferences dialog provides numerous controls relating to the functionality of the Interactive Routing feature within the PCB workspace.

Access

The PCB Editor – Interactive Routing page is accessed by clicking Interactive Routing under the PCB Editor folder in the main Preferences dialog (accessed by clicking the  button in the top right corner of the workspace).

Options/Controls

Routing Conflict Resolution 

  • Ignore Obstacles - Select to have the interactive router to allow the track to pass through obstacles while routing. 
  • Push Obstacles - Select to have the Interactive Router move existing tracks out of the way while routing. This mode can also push vias to make way for the new routing. If the system cannot push an obstacle without causing a violation, an indicator appears to show the route is blocked.
  • Walkaround Obstacles - Select to have the Interactive Router route around existing tracks, pads, and vias while routing. If the system cannot walkaround an obstacle without causing a violation, an indicator appears to show the route is blocked.
  • Stop At First Obstacle - Select to have the Interactive Router stop routing when it encounters the first obstacle in its path.
  • Hug And Push Obstacles - Select to have the Interactive Router hug existing tracks, pads, and vias as closely as possible while routing and, where necessary, push obstacles to continue the route. If the system cannot hug or push an obstacle without causing a violation, an indicator appears to show the route is blocked.
  • AutoRoute On Current Layer - Select to enable auto-routing on the current layer. This mode applies autorouter intelligence to the interactive router, automatically selecting between pushing and walking around, to give the shortest overall route length.
  • AutoRoute On Multiple Layers - Select to enable auto-routing on multiple layers. This mode also applies autorouter intelligence to the interactive router, automatically selecting between pushing, walking around or switching layers, to give the shortest overall route length.
  • Current Mode - This field displays the current Routing Conflict Resolution mode chosen when using the Interactive Router. Use the associated drop-down to change the mode as required.
You can switch routing modes on-the-fly using Shift + R during routing.

Interactive Routing Options

  • Restrict to 90/45 - Enable to restrict the routing to 90 degrees and 45 degrees only.
  • Follow Mouse Trail - Enable this option to activate routing through mouse trail.
  • Automatically Terminate Routing - When enabled, when you complete a route to the target pad, the routing tool does not continue in routing mode from the target pad but instead resets, ready for you to click on the next source pad from which to route. If this option is disabled, after you route to the target pad, the tool will remain in routing mode, using the previous target pad as the source for the next route.
  • Automatically Remove Loops - Enable to automatically remove any redundant loops that are created during manual routing. This allows you to re-route a connection without having to manually remove redundant tracks. However, there are times when you need to route nets (such as power nets) and you need loops. In this case, you can toggle the Remove Loops option for a selected net by editing its net property from the Edit Net dialog via the PCB panel. The Remove Loops local setting for the specified net overrides this global setting for the same net.
    • Remove Net Antennas - Enable to automatically remove any track or arc end that is not connected to any other primitive and therefore forms an antenna.
  • Allow Via Pushing - Check this option to allow pushing vias when you are in Push Obstacles or HugNPush Obstacles mode (selected above in Current Mode).
  • Display Clearance Boundaries - With this option enabled, as you interactively route, the no-go clearance area defined by the existing objects and the applicable clearance rule is displayed as shaded polygons giving you an indication of just how much space you have available for routing.
    • Reduce Clearance Display Area - By default, all clearance boundaries are displayed, however, you can opt to reduce the clearance display area by enabling this option to only view boundaries that fall within a localized viewing circle.
The display of clearance boundaries is available in all routing modes except Ignore Obstacles.

Routing Gloss Effort

  • Off - In this mode, glossing is essentially disabled. Note, however, that cleanup is still run after routing/dragging occurs to eliminate, for example, overlapping track segments. This mode is typically useful at the end stage of board layout when the ultimate level of fine-tuning is required (for example, when manually dragging tracks, cleaning pad entries, etc.).
  • Weak - In this mode, a low level of glossing is applied with the Interactive Router considering only those tracks directly connected to or in the area of the tracks that you are currently routing (or tracks/vias being dragged). This mode of glossing is typically useful for fine-tuning track layout or when dealing with critical traces.
  • Strong - In this mode, a high level of glossing is applied with the Interactive Router looking for shortest paths, smoothing out tracks, etc. This mode of glossing is typically useful in the early stages of the layout process when the aim is to get a large portion of the board routed quickly.

Dragging

  • Preserve Angle When Dragging - Enable this option to preserve the angle when dragging. When enabled, select one of the following options:
    • Ignore Obstacles - Obstacles will be ignored to preserve angle during dragging.
    • Avoid Obstacles (Snap Grid) - Based on the snap grid, software will try to avoid obstacles while preserving angles.
    • Avoid Obstacles - Software will try to avoid obstacles during dragging.
  • Unselected via/track - Set the default behavior of dragging an unselected via or track to be either a Move or Drag action.
  • Selected via/track - Set the default behavior of dragging a selected via or track to be either a Move or Drag action.
  • Component pushing - This field displays the current Component Conflict Resolution mode when moving components within the workspace. The following modes are supported:
    • Ignore - default behavior, where the component can be moved regardless of creating a violation with neighboring component(s). In this mode, the same component clearance checking routines seen in previous versions of Altium Designer are used. These routines use the 3D body (if there is one) or the copper and silk primitives to identify an object's clearance.
    • Push - the component will push other components away to provide compliance with clearances between components. Components in unions can be pushed and the location of components in the union may change but the union will not break. Locked components cannot be pushed. In this mode, components are identified by their selection boundary, which is the smallest possible rectangle that encloses all of the primitives in the component.
    • Avoid - the component will be forced to avoid violating clearance rules between other components. In this mode, components are identified by their selection boundary, which is the smallest possible rectangle that encloses all of the primitives in the component.
You can cycle through placement modes by pressing the R key during placement.

Interactive Routing Width Sources

  • Pickup Track Width From Existing Routes - Enable to use the existing track width when routing from an placed track (i.e., even if the current routing width is different to the existing track, the existing track width will be adopted when you continue the route from it).
  • Track Width Mode - Choose a track width mode for interactive routing. The available modes are:
    • User Choice - With this mode enabled, the width is determined from the width selected in the Choose Width dialog - accessed by pressing Shift + W while routing.
    • Rule Minimum- With this mode enabled, the design rule minimum width defined for the current net will be used.
    • Rule Preferred - With this mode enabled, the design rule preferred width defined for the current net will be used.
    • Rule Maximum - With this mode enabled, the design rule maximum width defined for the current net will be used.
  • Via Size Mode - Choose one of the via size modes for interactive routing. The available modes are:
    • User Choice - With this mode enabled, the via size is determined from the size selected in the Choose Via Sizes dialog - accessed by pressing Shift + V while routing.
    • Rule Minimum - This mode uses the minimum via size rule.
    • Rule Preferred - This mode uses the preferred via size rule.
    • Rule Maximum - This mode uses the maximum via size rule.

Favorites

  • Favorite Interactive Routing Widths - Click this button to open the Favorite Interactive Routing Widths dialog in which you can configure routing widths.

 

Found an issue with this document? Highlight the area, then use Ctrl+Enter to report it.

お問合せ

お近くの営業所にお問合せください。

You are reporting an issue with the following selected text
and/or image within the active document:
Altium Designer 無償評価版
Altium Designer 無償評価版
Altium Designerを使用していますか?

弊社の営業担当より詳細情報をご案内しますので、アルティウムジャパン までお問い合わせください。.
Copyright © 2019 Altium Limited

評価版ライセンスが必要な理由を下記から選択してください。

弊社の営業担当より詳細情報をご案内しますので、アルティウムジャパン までお問い合わせください。.
Copyright © 2019 Altium Limited

その場合、評価版ライセンスは不要です。

ボタンをクリックして、最新のAltium Designerインストーラをダウンロードしてください。

Altium Designerインストーラをダウンロードする

弊社の営業担当より詳細情報をご案内しますので、アルティウムジャパン までお問い合わせください。.
Copyright © 2019 Altium Limited

Altium Designerの新規ライセンスのお見積もりをご希望の場合、下記のフォームに入力してください。

プライバシーポリシーに同意の上、[ダウンロード]をクリックしてください。ご登録いただきましたメールアドレスにメールマガジンが送信されます。メール配信の停止は、メール内の​通知設定​​でお手続きいただけます。

Altium Designerサブスクリプションをご利用中の場合、評価版ライセンスは不要です。

お客様がAltium Designerサブスクリプションの有効なメンバーではない場合、下記のフォームに入力して無償評価版をダウンロードしてください。

プライバシーポリシーに同意の上、[ダウンロード]をクリックしてください。ご登録いただきましたメールアドレスにメールマガジンが送信されます。メール配信の停止は、メール内の​通知設定​​でお手続きいただけます。

Altium Designerを評価する理由を下記から選択してください。

弊社の営業担当より詳細情報をご案内しますので、アルティウムジャパン までお問い合わせください。.
Copyright © 2019 Altium Limited

無償評価版を使用するには、下記のフォームに入力してください。

プライバシーポリシーに同意の上、[ダウンロード]をクリックしてください。ご登録いただきましたメールアドレスにメールマガジンが送信されます。メール配信の停止は、メール内の​通知設定​​でお手続きいただけます。

Great News!

Valid students can get their very own 6-month Altium Designer Student License for FREE! Just fill out the form below to request your Student License today.

プライバシーポリシーに同意の上、[ダウンロード]をクリックしてください。ご登録いただきましたメールアドレスにメールマガジンが送信されます。メール配信の停止は、メール内の​通知設定​​でお手続きいただけます。

その場合、Altium Designerビューワーの無償ライセンス(有効期間6か月)をダウンロードできます。

下記のフォームに入力してライセンスをリクエストしてください。

プライバシーポリシーに同意の上、[ダウンロード]をクリックしてください。ご登録いただきましたメールアドレスにメールマガジンが送信されます。メール配信の停止は、メール内の​通知設定​​でお手続きいただけます。

素晴らしいですね。アルティウムではモノづくりに最適なプログラムを提供しています。

Upverterは、コミュニティ主導型の無償プラットフォームで、お客様のような作り手の要求に合わせて設計されています。

試してみる場合、こちらをクリック してください。

弊社の営業担当より詳細情報をご案内しますので、アルティウムジャパン までお問い合わせください。.
Copyright © 2019 Altium Limited

その場合、Altium Designerビューワーの無償ライセンス(有効期間6か月)をダウンロードできます。

下記のフォームに入力してライセンスをリクエストしてください。

プライバシーポリシーに同意の上、[ダウンロード]をクリックしてください。ご登録いただきましたメールアドレスにメールマガジンが送信されます。メール配信の停止は、メール内の​通知設定​​でお手続きいただけます。