Defining High Speed Signal Paths with xSignals

Updated: October 08, 2026

At a Glance

This article explains how xSignals in Altium Designer help you define and manage real high speed signal paths when a simple net is not enough, especially in designs that include series termination components, branches, Balanced T routing, or Fly-By topologies. It shows why traditional net-based length matching can fall short, how xSignals let you treat a signal as a complete path between source and destination, and how they support design rules such as Length and Matched Lengths during routing and tuning. You will also get a clear introduction to the related query keywords and the differences between nets, From-Tos, and xSignals, so you can better align PCB rules with actual design intent. Keep reading to see how this feature can make complex high speed constraints easier to define and manage.

- Understand why high speed timing and signal integrity requirements can be difficult to manage with standard nets alone.
- Learn how xSignals let you define signal paths through components and branches so design rules reflect real routing intent.
- Get familiar with key xSignal query keywords and the terminology that supports rule setup and signal path management.

Go Deeper with AI:

The Challenge

With ever-increasing device switching speeds comes the challenge of maintaining the integrity of the signal, and meeting the signal's timing requirements. The signal integrity can be managed through controlled impedance routing, which is achieved through the careful design of both the PCB stackup and the routing widths to be used on each layer.

The timing requirements are met by matching the routed lengths of the signal paths. For a set of 2-pin signal paths, each running from an output pin to a single input pin, calculating and comparing the lengths is a straightforward process. This is not the case for many typical design solutions though where there may be a series termination component in the signal path, or there are more than two pins in the signal, which could then be routed using a Balanced T or a Fly-By routing topology, as shown in the image below.

Four DDR2 RAM chips routed using a Balanced T topology. ##

The Solution

The designer's job is to translate their design requirements, such as the maximum route length allowed to meet the timing budget, into a set of design rules, such as a Length rule to ensure that the timing is met, and a Matched Lengths rule to detect potential timing mismatches.

Now the designer sees the signals in terms of their function (eg, 'This address signal must be routed from this connector to each memory device. To achieve that I'll route using a fly-by topology with a termination resistor at the end. I might also require a series terminator at the source'). Even though address A0 passes through a termination resistor, to the designer, that signal is still A0 on the other side of that resistor.

But the PCB editor sees each signal simply as a set of connected pins (commonly referred to as a net) — Net A0 goes from this connector pin to this memory component pin, then to this memory component pin, and so on. As soon as a series termination resistor is added, that address line becomes two discrete nets. This makes it difficult for the designer to specify key design requirements, such as Length and Matched Lengths design rules.

This can be managed by a feature called xSignals (or extended Signal). This feature enables the correct treatment of a high-speed signal path as just that - a path for a signal to travel between a source and destination, through termination components as well as branches.

An xSignal is essentially a designer-defined signal path between two nodes. These can be two nodes within the same net, or they can be two nodes in associated nets separated by a component. The xSignal can then be used to scope relevant design rules such as Length and Matched Lengths, which will then be obeyed during design tasks, such as interactive length tuning.

To learn more about creating xSignals, refer to the Creating an xSignal page.
To learn more about managing xSignals using the PCB panel, refer to the Managing xSignals page.
To learn more about setting requirements for xSignals in a PCB design, refer to the Design Rule Support for xSignals page.
To learn more about accounting pin package delay values in a PCB design, refer to the Pin Package Delay page.

xSignal Query Keywords

The PCB editor includes a powerful and sophisticated filtering engine. This engine is used to identify objects when searching for objects in the design space, applying rules during interactive and automatic design tasks, and for checking rule compliance. The designer tells the filtering engine which objects they are interested in by writing a query, using query keywords recognized by the filtering engine.

The following xSignal type query keywords have been added for use in design rules and design space filters:

Membership Check Type Keywords

InxSignal - Is the object in the specified xSignal, e.g., InxSignal('DRAM_A0_PP1')
InxSignalClass - Is the object in the specified xSignal class, e.g., InxSignalClass('PCIE')
IsxSignal - Is the object an xSignal with the specified name, e.g., IsxSignal('DRAM_A0_PP1')

Attribute Check Type Keyword

InAnyxSignal - Is the object in any xSignal, e.g., InAnyxSignal

Net-related Terminology

In the PCB editor, the following terminology is used:

Net – a collection of components pins (nodes) that are connected to each other. The arrangement of how those nodes connect to each other is referred to as the topology; the default topology is shortest.
From-To – conceptually, a From-To runs between two nodes in a net. The From-Tos can be created to follow the topology or arrangement of nodes in that net. For example, the net topology could be from R1-1 to U1-5 to U3-2 to R5-2. This net could have three From-Tos: R1-1 to U1-5; U1-5 to U3-2; and U3-2 to R5-2. If the topology is changed so will the possible From-Tos. From-Tos are created in the From-To mode of the PCB panel by either clicking the Generate button to create them based on a topology, or by selecting two pads in a net then clicking the Add From To button.
xSignal – a user-defined set of nodes, typically a sub-set of a net (from this node to that node), or a combination of two nets that include a series component, such as a termination resistor.

## Thanks to Robert Feranec of the FEDEVEL Academy (www.fedevel.com) for the use of the iMX6 Rex development board in images on this page (http://www.imx6rex.com/).

Printer-friendly version

If you find an issue, select the text/image and pressCtrl + Enterto send us your feedback.

Feature Availability

The features available to you depend on which Altium solution you have – Altium Develop, Altium Agile Teams, Altium Agile Enterprise, or Altium Designer (on active term).

If you don’t see a documented feature in your actual software, contact Altium Sales to find out more.

Legacy Documentation

Altium Designer documentation is no longer versioned. If you need to access documentation for older versions of Altium Designer, visit the Legacy Documentation section of the Other Installers page.