Contact our corporate or local offices directly.
Parent page: Analyzing Your Power Networks
Provided as a downloadable Altium Extension application, the Power Analyzer by Keysight, enabled by Keysight Technologies, integrates directly with Altium Designer to allow PI-DC simulation and analysis of the current PCB project. Rather than relying on simple cross-sectional area calculations to determine the current carrying capacity of the power network, the Power Analyzer first accurately models the copper structures, and then calculates the power delivery voltages and currents across the PCB. With results presented in both visual and tabular form, the engineer can use this feedback and quickly adjust the track widths, copper thicknesses, and via properties to ensure they achieve the integrity of DC power delivery required for their design.
To perform a Power Integrity analysis in Altium, the engineer first creates a hierarchical network of the entire power delivery system, identifying each power and return net, the sources and loads, as well as any series elements present in each section of the power network. Once the network and configuration settings have been defined, the Power Analyzer can examine the entire network.
The Power Analyzer examines the flow of energy through the copper pathways in the power network. The power network is defined by identifying and configuring the various network elements, including the net, the source, any series components, and the loads. To configure the power network:
Add an Analysis document to the Project
Analysis is configured and run from a Power Analyzer by Keysight document (
Configure the Board Properties
The Power Analyzer needs to know the physical properties of the board, such as the allowable current density, the type of copper, the working temperature, and so on. Confirm that the default values defined in the Configuration section of the analyzer document are suitable for your design.
Automatic Power Net Identification
The Power Analyzer can attempt to identify the power nets automatically. To do this, it needs to know how to identify circuit elements such as voltage regulators, connectors, and series components. As well as using clues such as component designator prefixes, you can also add parameters to certain components to enhance the automatic detection process. Learn more about Configuring the Auto-Define Settings.
Choose the Power Net(s)
Click for automatic power net identification, or click to manually select the power net(s). Learn more about defining the Power Nets.
Extend the Net(s)
If the power net passes through a series component such as a fuse, extend the net and identify the series components and chained nets. Learn more about extending a net.
Identify and Configure the Source
Each power net starts from a Source, such as a connector. Enable the source in the Add Source dialog, then click the Gear icon to configure that source. Learn more about identifying and configuring the Source.
Identify the Loads
Start with the major current consumers, including the Voltage Regulator Modules (VRMs). Learn more about identifying the Loads.
Configure the Loads and VRMs
Click the gear icon to open the Load Properties dialog, and configure each load. When a device is configured as a Voltage Regulator Module (VRM), a child power network is automatically created in the hierarchy with that VRM as the source.
Identify the Loads in the Child Power Nets
Ensure that the major load components are included in each power net.
Confirm the Power Network
Click the button to confirm that the power network is ready to test.
Ready for Analysis
Check the Tree to visually confirm that each power network is complete. To move from one power net to another, click on the Power Analyzer by Keysight link to return to the power net document, and select the Tree for each power net. When this is complete, you're ready to analyze the power network.
Once the Power Networks have been defined, you're ready to analyze the DC power distribution across and through the board.
Analyze the Copper Structures
Based on the Configuration settings, when you click the button, the copper structures present in the board are analyzed and simulated to determine the current flows and voltage drops.
Show on PCB
A Summary of the Voltage Drop, Current Density and Max Via Current analysis results are shown as part of the Power Net Definition in the
Examine the Heatmaps
The calculated current flow and voltage drops are displayed as Heatmaps, directly in the PCB editor. Use the PCB editor Layer tabs to examine the heatmap on each layer, switch between 2D and 3D PCB view modes with the standard 2 and 3 shortcuts, and click the Show Heatmap button in the Power Analyzer by Keysight panel to switch between the power analysis Heatmaps, and the standard PCB display modes.
Explore the Analysis Results
In the PCB editor, the power network analysis result you are examining is controlled via the Power Analyzer by Keysight panel. At the top of the panel, select the power network/net whose Heatmap you want to display. Note that if there are violations present in the design, the default is to include Only nets with violations in the dropdown, clear that option to include all power nets in the list. Learn more about the Power Analyzer by Keysight Panel.
Switch between Current Density and Voltage Drop
The Heatmap displays either the Current Density through the copper or the Voltage Drop across the copper, use the buttons at the top of the Heatmap tab of the panel to select the required mode. A scale for the Heatmap is displayed below the board, automatically scaled for current from Zero to Max Current Density, or for voltage drop from (Voltage - VDrop) to Voltage. Directional arrows indicating current flow can be displayed on the Heatmap, and the Current Density or Voltage Drop scale can be adjusted. Learn more about configuring and controlling the display of the Heatmap.
Exploring the Voltage Drop
The location of current density hotspots can be directly identified by their color on the heatmap. Because it is calculated as a difference between locations, understanding the voltage drops requires deeper interpretation. To assist in identifying critical locations, use the Enable Visual Slider for Voltage Contour option to display pre-defined contour lines, either as a voltage or as a percentage. Learn more about the Heatmap for Voltage Drop.
Probing the Results
To take a measurement directly from the Heatmap, place a Probe. Place a single Probe to display the absolute Current or Voltage at that location, or click at a second location to measure the difference between the two Probe points. The type of measurement (V or I) is determined by the current Heatmap mode (Current Density or Voltage Drop). Note that probing the center-point of a thru-hole will always display the Current Density. Learn more about Probes.
Examine the Ground Net Results
By default, the Ground net is excluded from the Heatmap results. Disable the Skip Ground checkbox in the Configuration section of the
The Power Analyzer provides detailed feedback, directly in the PCB editor. From the Power Analyzer by Keysight panel, violations can quickly be investigated, measurement probes placed, and heatmaps captured as images. To access detailed information about the DC power analysis of your board, a report can be generated. The detailed report opens inside the
pdnaK document, and from there, you can save preferred sections into an HTML report file. The report can either be for an individual power net, or the entire power network.
Working with the Interactive Graphical Results
Working from the interactive Power Analyzer by Keysight panel, you can quickly identify and examine violations.
Generating the Report
To generate a detailed report, click the button in the Power Analyzer by Keysight document (
Detailed Net Report - Parameters
The Full Report lists all the power nets that have been analyzed; click a Net Name to open the detailed report for that net. The left side of the Net report lists:
Detailed Net Report - Results
The right side of the report includes collapsible sections for:
Detailed Net Report - Network Details
Use the Network Details section to quickly identify potential issues in the design. This section lists:
Save the Report
To create an HTML report of the analyses, click the button. In the Save Report Settings dialog, configure the required power Networks and Data that you would like to include, then click button to save the report as a set of HTML files. The report is created in a date & time-stamped folder within the project folder,
Include Probe Results and Image Captures
Images captured via the button in the Power Analyzer by Keysight panel are automatically included at the end of the Network Details section of the HTML report, along with any images of Probe results saved using the the button.
It takes time to learn how to work with new design software. If you learn best by watching, then why not check out this video playlist that demonstrates some of the key features of How to Work with Power Analyzer by Keysight.
Contact our corporate or local offices directly.