Now reading version 1.0. For the latest, read: Region for version 4

This documentation page references Altium NEXUS/NEXUS Client (part of the deployed NEXUS solution), which has been discontinued. All your PCB design, data management and collaboration needs can now be delivered by Altium Designer and a connected Altium 365 Workspace. Check out the FAQs page for more information.


Parent page: PCB Objects

Examples of the various types of placed region objectsExamples of the various types of placed region objects


A Region, also known as a Solid Region, is a polygonal-shaped primitive object that can be placed on any layer. 

A region can have any number of sides and vertices (corners). It can be placed on a signal layer to define an area of solid copper to be used to provide shielding or to carry large currents. Positive regions can be combined with tracks or arc segments and be connected to a net. In the PCB Library editor, regions can be used to create custom pad shapes on copper layers or special mask shapes on the solder and paste masks. On non-electrical layers, regions can be used to define custom shapes for tasks such as logos.

When placed as a negative, a region can create a cutout (a void) in a polygon pour. In this mode, the region will not be filled with copper when the polygon is poured. When used as a negative region for a board cutout (by placing it on the multi-layer), it defines an area that becomes a hole through the finished board. Board cutout regions are transferred to Gerber and ODB++ files for manufacturing purposes through the use of a dedicated Rout layer.


Regions are available for placement in both the PCB editor and the PCB Library editors in one of the following ways:

  • PCB Editor:
    • Choose Place » Solid Region from the main menus.
    • Click the Solid Region button () in the drop-down on the Active Bar located at the top of the workspace. (Click and hold an Active Bar button to access other related commands. Once a command has been used, it will become the topmost item on that section of the Active Bar.)
    • Right-click in the workspace then click Place » Solid Region from the context menu.
  • PCB Library Editor:
    • Choose Place » Solid Region from the main menus.
    • Click the Solid Region button () in the drop-down on the Active Bar located at the top of the workspace. (Click and hold an Active Bar button to access other related commands. Once a command has been used, it will become the topmost item on that section of the Active Bar.)


After launching the command, the cursor will change to a crosshair and you will enter region placement mode. Placement is made by performing the following sequence of actions:

  1. Position the cursor then click to anchor the starting vertex for the region.
  2. Move the cursor ready to place the second vertex. The default behavior is to place two edges with each click, with a user-defined corner shape between them. Refer to the Placement Modes topic below for more details on changing corner modes.
  3. Continue to move the mouse and click to place further vertices.
  4. After placing the final vertex, right-click or press Esc to close and complete placement of the region. There is no need to manually close the region as the software will automatically complete the shape by connecting the start point to the final point placed.
  5. Continue placing further regions or right-click or press Esc to exit placement mode.

A region will adopt a net name if it is placed over an object that is already connected to a net.

Additional actions that can be performed during placement include:

  • Press the Tab key to pause the placement and access the Region mode of the Properties panel from where its properties can be changed on-the-fly. Click the workspace pause button overlay ( ) to resume placement.
  • Press the + and - keys on the numeric keypad to cycle forward and backward through all layers currently visible in the design.
  • Press the * key to cycle through the visible signal layers.​
While attributes can be modified during placement (Tab to access the Properties panel), keep in mind that these will become the default settings for further placement unless the Permanent option on the PCB Editor – Defaults page of the Preferences dialog is enabled. When this option is enabled, changes made will affect only the object being placed and subsequent objects placed during the same placement session.

Graphical Editing

Move Region Vertices

Regions contain two points, or "handles", with which to edit the shape of the region.

  1. Full Handles - located at the corners of the region.
  2. Empty Handles - located in the centers of the segments created by the Full Handles.

An existing region can be re-shaped by moving these handles, or vertices, located at each corner or at the center of each edge.

To modify the region shape:

  1. Click and select a region, which will highlight the vertices for the region and change the cursor to a crosshair.
    • Click on a Full Handle to move that corner.
    • Click along an edge to move the entire edge.
    • Click on an Empty Handle to move the whole side (for track and for arc).
    • Ctrl+Click on an Empty Handle to break that edge into two edges. Ctrl only needs to be held at the beginning of movement. The Shift+Spacebar hotkeys can then be used to cycle through modes (arc, miter, and any angle).

The various methods of moving region vertices. The various methods of moving region vertices.

  1. If the any angle placement mode creates unwanted vertices, or to remove extra vertices in general, click Ctrl and grab the central full handle. An X icon appears over the handle and dragging the edge will reduce the vertices on that edge to one.

Modify Region Border

In addition to vertex editing, you also can use the Modify Region Border command to easily change the shape of polygons. The command is run by right-clicking on the desired polygon then selecting Polygon Actions » Modify Polygon Border. Once the command is launched, the cursor becomes a crosshair. Each time you click, a new vertex is added. As during region placement, the Shift+Spacebar shortcuts can be used to change corner shapes.

Modifying a region border. Modifying a region border.

If attempting to graphically modify an object that has its Locked property enabled, a dialog will appear asking for confirmation to proceed with the edit. If the Protect Locked Objects option is enabled on the Schematic – Graphical Editing page of the Preferences dialog, and the Locked option for that design object is enabled as well, then that object cannot be selected or graphically edited. Click the locked object to select it then disable the Locked property in the List panel or disable the Protect Locked Objects option to graphically edit the object.

Non-Graphical Editing

The following methods of non-graphical editing are available:

Via the Properties Panel

Properties page: Region Properties

This method of editing uses the associated Properties panel mode to modify the properties of a Region object.

The Region mode of the Properties panel
The Region mode of the Properties panel

During placement, the Region mode of the Properties panel can be accessed by pressing the Tab key.

After placement, the Region mode of the Properties panel can be accessed in one of the following ways:

  • Double-click on the placed Region object.
  • Place the cursor over the Region, right-click then choose Properties from the context menu.
  • If the Properties panel is already active, select the Region object.

Quickly change the units of measurement currently used in the panel between metric (mm) and imperial (mil) using the Ctrl+Q shortcut. This affects the panel only and does not change the actual measurement unit employed for the board.

Editing via a List Panel

Panel pages: PCB List, PCBLIB List

List panel allows you to display design objects from one or more documents in tabular format, enabling quick inspection and modification of object attributes. Used in conjunction with appropriate filtering, it enables the display of just those objects falling under the scope of the active filter – allowing you to target and edit multiple design objects with greater accuracy and efficiency.

If you find an issue, select the text/image and pressCtrl + Enterto send us your feedback.