Validación de un componente

Updated: October 15, 2026

De un vistazo

Antes de guardar un componente de biblioteca en un Workspace conectado en Altium Designer, ejecute una comprobación de reglas de componentes para verificar que cumpla los requisitos configurados. Este artículo explica la validación automática y manual, dónde revisar las infracciones notificadas y cómo configurar comprobaciones definidas por el usuario. También ofrece orientación para resolver problemas como rutas de carpetas ausentes, identificadores duplicados y asignaciones de pines no válidas. Siga leyendo para identificar problemas en los componentes y resolver los fallos de validación antes de guardarlos en su Workspace.

- Aprenda a ejecutar una comprobación de reglas de componentes desde el editor de componentes, tanto en el modo de edición de un solo componente como en el de edición de componentes por lotes, y a revisar los resultados en el panel Mensajes.
- Comprenda qué fallos de validación impiden guardar un componente en el Workspace.
- Descubra dónde configurar las comprobaciones definidas por el usuario y cómo resolver las infracciones habituales de los componentes.

Profundiza con IA:

Antes de guardar un componente de la biblioteca del espacio de trabajo definido/editado en el editor de componentes (en modo de edición de un solo componente o de edición de componentes por lotes) en el espacio de trabajo conectado y hacer que el componente esté disponible para su uso en diseños, es esencial asegurarse de que cumpla los requisitos de acuerdo con los ajustes configurados. Cuando intenta guardar un componente en el espacio de trabajo, el editor de componentes ejecuta una validación: una comprobación de reglas de componentes.

Esta función también se puede ejecutar manualmente en cualquier momento seleccionando el comando Tools » Component Rule Check en los menús principales. Asegúrese de haber guardado el componente localmente (File » Save) antes de hacerlo.
El comando Component Rule Check también está disponible en el menú principal File del editor y en el menú contextual de la entrada del componente en el panel Projects.

Al igual que un proyecto de placa cuenta con un proceso de validación para detectar infracciones, el editor de componentes dispone de una función de validación de componentes. Las infracciones detectadas se enumeran en el panel Messages.

Detección de problemas en un componente antes de guardarlo en el espacio de trabajo. Aquí se muestra la ejecución del comando Component Rule Check desde el editor de componentes en modo Single Component Editing.

La validación de componentes comprueba una serie de posibles problemas en el componente y sus modelos definidos: tanto mediante comprobaciones predefinidas como mediante una serie de tipos de infracción que el usuario puede definir a nivel global.

Las siguientes comprobaciones de validación predefinidas tienen todas el modo de notificación :

Folder path not specified for component

Summary

Summary	This violation occurs when a target Workspace folder where a component being defined in the Component editor should be saved is not specified.
Notification	A notification will be displayed in the Messages panel in the following format: `Folder path not specified for component <ItemID>` where: `ItemID` is the ID used for the Component Item in the Workspace.
Recommendation for Resolution	In the Component editor in Single Component Editing mode, use the Folder field in the Component region (under Advanced Settings) to specify a folder in the target Workspace into which the component will be saved. To manually specify a target folder, click the button to access the Choose Folder dialog. Browse to, and choose an existing folder, or create a new one on-the-fly. In the Component editor in Batch Component Editing mode, use the FolderPath field (in the Component column group) in the component definition region of the editor to specify a folder in the target Workspace into which the component will be saved. To manually specify a target folder, click once inside the FolderPath field for a component to reveal the button, and click to access the Choose Folder dialog. Browse to, and choose an existing folder, or create a new one on-the-fly.

This violation occurs when a target Workspace folder where a component being defined in the Component editor should be saved is not specified.

Notification

A notification will be displayed in the Messages panel in the following format:

Folder path not specified for component <ItemID>

where:

ItemID is the ID used for the Component Item in the Workspace.

Recommendation for Resolution

In the Component editor in Single Component Editing mode, use the Folder field in the Component region (under Advanced Settings) to specify a folder in the target Workspace into which the component will be saved. To manually specify a target folder, click the button to access the Choose Folder dialog. Browse to, and choose an existing folder, or create a new one on-the-fly.
In the Component editor in Batch Component Editing mode, use the FolderPath field (in the Component column group) in the component definition region of the editor to specify a folder in the target Workspace into which the component will be saved. To manually specify a target folder, click once inside the FolderPath field for a component to reveal the button, and click to access the Choose Folder dialog. Browse to, and choose an existing folder, or create a new one on-the-fly.

Component not having a unique Id

Summary	This violation occurs when the Item ID of a component being defined in the Component editor is the same as the Item ID of another item in the connected Workspace.
Notification	A notification will be displayed in the Messages panel in the following format: `Duplicate Component Id: "<ItemID>"` where: `ItemID` is the ID used for the Component Item in the Workspace.
Recommendation for Resolution	In the Component editor in Single Component Editing mode, use the Id field in the Component region (under Advanced Settings) to specify another ID which is unique for the connected Workspace content. In the Component editor in Batch Component Editing mode, use the Item ID field in the Component column group of the component definition region to specify another ID which is unique for the connected Workspace content.
Note	This violation typically occurs when an automatically assigned Item ID value of a component is manually overridden. For a new component created through the File » New » Component command or the Components panel (learn more), this field is populated in accordance with the component template defined for the component type chosen in the Create new component dialog. Where a template does not exist, or where the <Undefined> entry is chosen in the dialog, a default naming scheme (`CMP-{00000}`) is used. For a new component created through the Explorer panel, this field is populated in accordance with the default naming scheme specified for that component's parent folder. If the parent folder has a component template attached, then defined component naming will be brought in from that template. Altium Designer will automatically assign the next available unique ID, based on that scheme, having scanned the entire Workspace and identifiers of existing content.

Las comprobaciones definibles por el usuario se configuran en la página Gestión de datos – Comprobaciones de reglas de componentes del cuadro de diálogo Preferences.

$Comprobaciones de infracciones definibles por el usuario que pueden configurarse como parte de las preferencias globales para utilizarlas al validar un componente.$
Comprobaciones de infracciones definibles por el usuario que pueden configurarse como parte de las preferencias globales para utilizarlas al validar un componente.

Si falla alguna de las pruebas predefinidas o alguna comprobación definida por el usuario con el nivel de Error fatal, no se podrá guardar el componente en el espacio de trabajo.

Es posible que la configuración predeterminada de las comprobaciones definidas por el usuario no sea adecuada para sus componentes, por lo que es importante familiarizarse con las opciones y con la forma de configurarlas para adaptarlas a sus diseños. A continuación encontrará información sobre cada comprobación de errores definida por el usuario.

Infracciones asociadas a los componentes

Duplicate Component by Name

Summary	This violation occurs when the name of a component being defined in the Component editor is the same as the name of a component in the connected Workspace.
Default Report Mode
Notification	A notification is displayed in the Messages panel in the following format: `Duplicate component by Name`
Recommendation for Resolution	Assign different and unique name(s) to the component(s) as required. In the Component editor in Single Component Editing mode, use the Name field in the Component region to specify another name which is unique for the components in the connected Workspace. In the Component editor in Batch Component Editing mode, use the Item ID field in the Component column group of the component definition region to specify another name which is unique for the components in the connected Workspace.

Duplicate Component by PCL

Summary	This violation occurs when a component being defined in the Component editor has a Part Choice that is used by another component in the connected Workspace.
Default Report Mode
Notification	A notification is displayed in the Messages panel in the following format: `Duplicate component by Part Choice list`
Recommendation for Resolution	Assign different and unique Part Choice(s) to the component(s) as required. In the Component editor in Single Component Editing mode, use the Part Choices region to change the list of component Part Choices to which is unique for the components in the connected Workspace. In the Component editor in Batch Component Editing mode, use the Part Choice n column group of the component definition region to change the list of component Part Choices to which is unique for the components in the connected Workspace.

Invalid Pin Mappings

Summary	This violation occurs when a component being defined in the Component editor has an ambiguous mapping between component symbol and footprint(s). For example, the violation occurs if the symbol has pins defined in their Designator fields as `1`, `2`, `3`, while the footprint has pads defined in their Designator fields as `B`, `C`, `E`, or when the number of symbol pins is larger than the number of footprint pads.
Default Report Mode
Notification	`Pin <PinDesignator> of the symbol <SymbolName> (<SymbolRevisionID>) does not have corresponding pad <PadDesignator> in footprint <FootprintName> (<FootprintRevisionID>)` where: `PinDesignator` is the symbol pin's Designator. `SymbolName` is the name of the symbol. `SymbolRevisionID` is the Item-Revision ID of the symbol. `PadDesignator` is the footprint pad's Designator. `FootprintName` is the name of the footprint. `FootprintRevisionID` is the Item-Revision ID of the footprint.
Recommendation for Resolution	Edit currently added or select another model to make sure that symbol pins have one-to-one matching to footprint pads. In the Component editor in Single Component Editing mode: Click the control at the top right of model's preview to modify the model that is currently being used (referenced) by the component in the corresponding temporary editor for that model type. Click the control at the top right of model's preview and choose the Select Model entry from the menu to browse for and choose, a different model, or a different revision of that same model. Click the control at the top right of symbol's preview to access the Pins panel and change the mapped pad/pin targets directly by clicking on a cell of the model and entering the required value. In the Component editor in Batch Component Editing mode: Right-click on the model entry in the Model Links region and choose the Edit command from the context menu to modify the model that is currently being used (referenced) by the component in the corresponding temporary editor for that model type. Click on the model's Item ID field in the Model Links region then click on the button to browse for and choose, a different model, or a different revision of that same model.

Missing Component Description

Summary	This violation occurs when the description of a component being defined in the Component editor is not specified.
Default Report Mode
Notification	A notification is displayed in the Messages panel in the following format: `Component Description is not specified`
Recommendation for Resolution	Specify a description for the offending component(s) as required. In the Component editor in Single Component Editing mode, use the Description field in the Component region to specify a description. In the Component editor in Batch Component Editing mode, use the Description field in the Component column group of the component definition region to specify a description for the offending component(s).

Missing Component Name

Summary	This violation occurs when the name of a component being defined in the Component editor is not specified.
Default Report Mode
Notification	A notification is displayed in the Messages panel in the following format: `Component Name is not specified`
Recommendation for Resolution	Specify a name for the offending component(s) as required. In the Component editor in Single Component Editing mode, use the Name field in the Component region to specify a name. In the Component editor in Batch Component Editing mode, use the Name field in the Component column group of the component definition region to specify a name for the offending component(s).

Missing Component Type

Summary	This violation occurs when the type of component being defined in the Component editor is not specified.
Default Report Mode
Notification	A notification is displayed in the Messages panel in the following format: `Component Type is not specified`
Recommendation for Resolution	Specify a type for the offending component(s) as required. In the Component editor in Single Component Editing mode, use the Type field in the Component region to specify a type. In the Component editor in Batch Component Editing mode, use the Type field in the Component column group of the component definition region to specify a type for the offending component(s).

Model Revision in Inapplicable State

Summary	This violation occurs when a linked model that is being used (referenced) by a component definition is detected to be in an inapplicable state. For example, the model is currently `Obsolete` and should therefore not be used. Applicability is determined through the Allowed to be used in designs option in the State Properties dialog. From within the Edit Lifecycle Definitions dialog, access this dialog for the required state, either by double-clicking on the state's entry within the parent lifecycle definition or by selecting its entry and clicking the edit icon that appears (). When this option is enabled, a model in this state is permitted to be used in a component. It is deemed to be Applicable. If this option is disabled, a model in this state cannot be validly used and is deemed Inapplicable (or non-applicable). The Edit Lifecycle Definitions dialog is itself accessed from the Data Management – Servers page of the Preferences dialog, by clicking the Properties button for the Workspace to which you are actively connected, then selecting Lifecycles from the drop-down menu. For more information about lifecycle definitions, refer to the Defining Lifecycle Definitions for a Workspace page.
Default Report Mode
Notification	A notification is displayed in the Messages panel in the following format: `<ModeName> (<ModelRevisionID>) revision is in inapplicable state` where: `ModelName` is the name of the model. `ModelRevisionID` is the Item-Revision ID of the model.
Recommendation for Resolution	Choose a replacement model or revision of the same model that is valid for use in the component. In the Component editor in Single Component Editing mode, click the control at the top right of model's preview and choose the Select Model entry from the menu to browse for and choose, a different model, or a different revision of that same model. In the Component editor in Batch Component Editing mode, click on the model's Item ID field in the Model Links region then click on the button to browse for and choose, a different model, or a different revision of that same model.

Model revision is Out Of Date

Summary	This violation occurs when a linked model that is being used (referenced) by a component definition is detected to be out of date. If there is a later revision of the model available, the Revision State field will reflect this using the text `Out of date`, to the right of the current revision's lifecycle state under the model's preview (in the Component editor in Single Component Editing mode), or the Revision Status field in the Model Links region will be flagged by the text `Out of date`, shown in bold font (in the Component editor in Batch Component Editing mode).
Default Report Mode
Notification	A notification is displayed in the Messages panel in the following format: `<ModelName> (<ModelRevisionID>) revision is Out of Date` where: `ModelName` is the name of the model. `ModelRevisionID` is the Item-Revision ID of the model.
Recommendation for Resolution	Update the component model links that are out-of-date to use the latest revision of the models. In the Component editor in Single Component Editing mode, click the control at the top right of the model's preview and choose the Update to Latest entry from the menu. In the Component editor in Batch Component Editing mode, right-click anywhere on the model's entry in the Model Links region and choose Update to Latest Revision from the menu.

Number of Pads Exceeds Number of Pins

Summary	This violation occurs when a footprint model that is being used (referenced) by a component definition includes more pads (SMD pads placed on copper layers and plated thru-hole pads) than pins of its referenced schematic symbol.
Default Report Mode
Notification	A notification is displayed in the Messages panel con el siguiente formato: `Number of pads in the footprint <FootprintName> (<FootprintRevisionID>) (<FootprintNumberOfPads>) exceeds number of pins in the symbol <SymbolName> (<SymbolRevisionID>) (<SymbolNumberOfPins>)` donde: `FootprintName` es el nombre de la huella. `FootprintRevisionID` es el ID de elemento-revisión de la huella. `FootprintNumberOfPads` es el número de pads de la huella. `SymbolName` es el nombre del símbolo. `SymbolRevisionID` es el ID de elemento-revisión del símbolo. `SymbolNumberOfPins` es el número de pines del símbolo.
Recomendación para la resolución	Edite el modelo de símbolo/huella añadido actualmente o seleccione otro para asegurarse de que el número de pads de la huella no supere el número de pines del símbolo. En el editor de componentes, en el modo de edición de un solo componente: Haga clic en el control situado en la esquina superior derecha de la vista previa del modelo para modificar el modelo que el componente utiliza (referencia) actualmente en el editor temporal correspondiente a ese tipo de modelo. Haga clic en el control situado en la esquina superior derecha de la vista previa del modelo y elija la opción Select Model del menú para buscar y seleccionar otro modelo u otra revisión del mismo modelo. En el editor de componentes, en el modo de edición de componentes por lotes: Haga clic con el botón derecho en la entrada del modelo en la región Model Links y elija el comando Edit del menú contextual para modificar el modelo que el componente utiliza (referencia) actualmente en el editor temporal correspondiente a ese tipo de modelo. Haga clic en el campo Item ID del modelo en la región Model Links y, a continuación, haga clic en el botón para buscar y seleccionar otro modelo u otra revisión del mismo modelo.

Revision Being Edited is Not Latest

Summary	This violation occurs when the component revision being edited is not the latest revision available in the connected Workspace.
Default Report Mode
Notification	A notification is displayed in the Messages panel in the following format: `<ComponentName> (<ComponentRevisionID>) revision is Out of Date` where: `ComponentName` is the component's Name. `ComponentRevisionID` is the Item-Revision ID of the component.
Recommendation for Resolution	Select the latest component revision for editing. To do this, browse for the component in the Components panel, right-click its entry in the panel and choose Edit.

Unrecognized Combination of Manufacturer+Part Number in Part Choice

Summary	This violation occurs when an incorrect entry for a component's part choice is added, and the part can not be retrieved by the Workspace.
Default Report Mode
Notification	A notification is displayed in the Messages panel in the following format: `Manufacturer+Part Number combination was not found in the available Part Sources ("Part Choice <n>")` where: `n` is the sequential number of the offending part choice.
Recommendation for Resolution	Specify valid part choice for the offending component(s). In the Component editor in Single Component Editing mode, remove invalid part choices from the Part Choices region and add new, correct part choices. In the Component editor in Batch Component Editing mode, enter correct values to the Part Choice n fields in the component definition region. Note that while a part choice field value has an incorrect entry, the text will appear greyed and in italics. Once both entries are correct, the text will appear as normal, white text.

Infracciones asociadas a las huellas

Duplicate Pad Designator

Summary	This violation occurs when a footprint model linked to a component being defined in the Component editor has multiple pad objects with the same value of the Designator property.
Default Report Mode
Notification	A notification is displayed in the Messages panel in the following format: `Duplicate Pad Designator On Pads Pad <Identifier1> on <Layer1> And Pad <Identifier2> on <Layer2>` where: `Identifier1` is the identifier for the first instance of the pad with a duplicated designator, represented by the net-designator pairing and pad coordinates. `Layer1` is the layer on which the first instance of the pad with a duplicated designator is placed. `Identifier2` is the identifier for the second instance of the pad with a duplicated designator, represented by the net-designator pairing and pad coordinates. `Layer2` is the layer on which the second instance of the pad with a duplicated designator is placed.
Recommendation for Resolution	Assign different and unique designators to the pads of the linked footprint model. In the Component editor in Single Component Editing mode, click the control at the top right of footprint's preview. In the Component editor in Batch Component Editing mode, right-click on the footprint entry in the Model Links region and choose the Edit command from the context menu. The footprint model that is currently being used (referenced) by the component will open in the temporary PCB Library editor. Select offending pads and change values of their Designator property in the Properties panel when a pad is selected (learn more).

Duplicate Primitives

Summary	This violation occurs when a footprint model linked to a component being defined in the Component editor has identical objects placed in the same location on the same layer.
Default Report Mode
Notification	A notification is displayed in the Messages panel con el siguiente formato: `Duplicate Primitives: <ObjectType1> <Identifier1> on <Layer1> And <ObjectType2> <Identifier2> on <Layer2>` donde: `ObjectType1` es el tipo de la primera instancia del objeto duplicado. `Identifier1` es el identificador de la primera instancia del objeto duplicado; la representación del identificador depende del tipo de objeto. `Layer1` es la capa en la que se coloca la primera instancia del objeto duplicado. `ObjectType2` es el tipo de la segunda instancia del objeto duplicado. `Identifier2` es el identificador de la segunda instancia del objeto duplicado; la representación del identificador depende del tipo de objeto. `Layer2` es la capa en la que se coloca la segunda instancia del objeto duplicado.
Recomendación para la resolución	Elimine los objetos duplicados del modelo de huella. En el editor de componentes, en el modo de edición de un solo componente, haga clic en el control situado en la esquina superior derecha de la vista previa de la huella. En el editor de componentes, en el modo de edición de componentes por lotes, haga clic con el botón derecho en la entrada de la huella en la región Model Links y seleccione el comando Edit del menú contextual. El modelo de huella que el componente utiliza actualmente (al que hace referencia) se abrirá en el editor temporal de bibliotecas de PCB. Seleccione los objetos duplicados y elimínelos mediante el atajo de teclado Delete.

Mirrored Footprint (designed on bottom layer)

Summary	This violation occurs when a footprint model linked to a component being defined in the Component editor has significant primitives (pads, tracks, arcs, fills, regions, rectangles, text strings, keepout objects) placed on the `Bottom Layer` but has no such primitives placed on the `Top Layer`. In the PCB Library editor, the footprint is built for the top side of the board; it can be flipped to the bottom during the PCB design process if required.
Default Report Mode
Notification	A notification is displayed in the Messages panel in the following format: `Bottom Layer Component`
Recommendation for Resolution	Flip footprint primitives from the `Bottom Layer` to the `Top Layer`. In the Component editor in Single Component Editing mode, click the control at the top right of footprint's preview. In the Component editor in Batch Component Editing mode, right-click on the footprint entry in the Model Links region and choose the Edit command from the context menu. The footprint model that is currently being used (referenced) by the component will open in the temporary PCB Library editor. Select primitives on the `Bottom Layer`, and change their Layer property in the Properties panel to the `Top Layer`. Selected objects can also be quickly flipped to the other side of the board using the `L` shortcut. To do this, select objects to be flipped, hold the left mouse button on one of the selected objects and press the `L` key, then release the left mouse button.

Missing Pad Designator

Summary	This violation occurs when a footprint model linked to a component being defined in the Component editor has a Pad object with no value of the Designator property specified.
Default Report Mode
Notification	A notification is displayed in the Messages panel in the following format: `Missing Pad Designator on Pad: Pad <Identifier> on <Layer>` where: `Identifier` is the identifier for the pad with no designator specified, represented by the pad net and coordinates. `Layer` is the layer on which the pad with no designator specified is placed.
Recommendation for Resolution	Specify designator values for the pads of the linked footprint model. In the Component editor in Single Component Editing mode, click the control at the top right of footprint's preview to open the footprint that is currently being used (referenced) by the component in the temporary PCB Library editor. In the Component editor in Batch Component Editing mode, right-click on the footprint entry in the Model Links region and choose the Edit command from the context menu. The footprint model that is currently being used (referenced) by the component will open in the temporary PCB Library editor. Select an offending pad and specify the value of its Designator property in the Properties panel when a pad is selected (learn more).

Offset Footprint Reference

Summary	This violation occurs when a footprint model linked to a component being defined in the Component editor has its reference point (origin) outside of the bounding rectangle formed by footprint objects.
Default Report Mode
Notification	A notification is displayed in the Messages panel in the following format: `Offset Component Origin`
Recommendation for Resolution	Change the location of the reference point for it is inside the bounding rectangle formed by footprint objects. In the Component editor in Single Component Editing mode, click the control at the top right of footprint's preview to open the footprint that is currently being used (referenced) by the component in the temporary PCB Library editor. In the Component editor in Batch Component Editing mode, right-click on the footprint entry in the Model Links region and choose the Edit command from the context menu. The footprint model that is currently being used (referenced) by the component will open in the temporary PCB Library editor. Use the commands of the Edit » Set Reference sub-menu of the main menus to change the current location of the footprint's reference.

Shorted Copper

Summary	This violation occurs when a footprint model linked to a component being defined in the Component editor has pad que están conectados entre sí mediante objetos en una capa de cobre.
Modo de informe predeterminado
Notificación	Se muestra una notificación en el panel Messages con el siguiente formato: `Shorted Copper Connection Between Pad <Identifier1> on <Layer1> And Pad <Identifier2> on <Layer2>` donde: `Identifier1` es el identificador de la primera instancia del pad en el par de pads cortocircuitados, representado por la combinación de red y designador y las coordenadas del pad. `Layer1` es la capa en la que se coloca la primera instancia del pad del par de pads cortocircuitados. `Identifier2` es el identificador de la segunda instancia del pad en el par de pads cortocircuitados, representado por la combinación de red y designador y las coordenadas del pad. `Layer2` es la capa en la que se coloca la segunda instancia del pad del par de pads cortocircuitados.
Recomendación para la resolución	Elimine los objetos de la capa de cobre que conectan los pads del modelo de huella vinculado. En el editor de componentes, en el modo de edición de un solo componente, haga clic en el control situado en la esquina superior derecha de la vista previa de la huella. En el editor de componentes, en el modo de edición de componentes por lotes, haga clic con el botón derecho en la entrada de la huella en la región Model Links y elija el comando Edit del menú contextual. El modelo de huella que el componente utiliza actualmente (al que hace referencia) se abrirá en el editor temporal de bibliotecas de PCB. Seleccione los objetos de la capa de cobre que conectan los pads y modifíquelos para que no conecten los pads, o elimínelos.

Unconnected Copper

Summary	This violation occurs when a footprint model linked to a component being defined in the Component editor has objects on a copper layer, and these objects are not connected to any pad objects. When such a footprint will be placed in a PCB design, a net will not be assigned to these copper layer objects, and they will become dead copper.
Default Report Mode
Notification	A notification is displayed in the Messages panel in the following format: `Unconnected Copper on primitive : <ObjectType> <Identifier> on <Layer>` where: `ObjectType` is the type of instance of the object that is not connected to any pad object in the footprint model. `Identifier` is the identifier for the object that is not connected to any pad object in the footprint model; the identifier representation depends on the object type. `Layer` is the layer on which the instance of the object that is not connected to any pad object in the footprint model is placed.
Recommendation for Resolution	Change the footprint model so the objects which are not currently connected to any Pad object in the footprint model are connected to pads. In the Component editor in Single Component Editing mode, click the control at the top right of footprint's preview. In the Component editor in Batch Component Editing mode, right-click on the footprint entry in the Model Links region and choose the Edit command from the context menu. The footprint model that is currently being used (referenced) by the component will open in the temporary PCB Library editor. Place objects on copper layer(s) to form a connection between footprint pads and objects which are not currently connected to any pad object or remove these unconnected objects.

Infracciones asociadas a los símbolos

Different Pins Between Modes

Summary	This violation occurs when one of the display modes for a symbol has an extra pin.
Default Report Mode
Notification	A notification is displayed in the Messages panel in the following format: `Extra Pin in display mode <DisplayMode> of the symbol <SymbolRevisionID>. Part <PartDesignator>. Pin Name "<PinName>"` where: `DisplayMode` is the specific graphical representation mode for the symbol in which the extra pin(s) has been found. A symbol has a Normal mode and can have up to 255 defined Alternate modes. Learn more about creating multiple graphical display modes of the same component symbol. `SymbolRevisionID` is the Item-Revision ID of the symbol. `PartDesignator` is the symbol part's Designator. `PinName` is the offending pin's Name.
Recommendation for Resolution	This violation typically arises when an alternate graphical mode is defined for a symbol and either: An extra pin has been added to a display mode that is not specified in another display mode, or A pin has been specified with a different Designator and/or Name to a pin specified in another display mode. Not only must there be an identical number of pins between graphical display modes, but the pins must be also identical in both Designator and Name. Learn more about creating multiple graphical display modes of the same component symbol. Change the Designator and/or Name of offending pin(s) so the number of pins and their Designator and Name properties are the same between the symbol's display modes or remove an extra pin from a display mode. In the Component editor in Single Component Editing mode, click the control at the top right of symbol's preview. In the Component editor in Batch Component Editing mode, right-click on the symbol entry in the Model Links region and choose the Edit command from the context menu. The symbol model that is currently being used (referenced) by the component will open in the temporary Schematic Library editor. Select offending pins and change values of their Designator and/or Name property in the Properties panel when a pin is selected (learn more), or remove these pins using the `Delete` shortcut.

Duplicate Pin Designators

Summary	This violation occurs when two or more pins in the component's symbol model have the same designator.
Default Report Mode
Notification	A notification is displayed in the Messages panel con el siguiente formato: `Duplicate Pin Designator(s) (mode <DisplayMode>): <PinDesignatorList>` donde: `DisplayMode` es el modo de representación gráfica específico del símbolo en el que se han encontrado los pines duplicados. Un símbolo tiene un modo Normal y puede tener hasta 255 modos Alternate definidos. `PinDesignatorList` es la lista, separada por comas, de los designadores de pin duplicados en el símbolo infractor.
Recomendación para la resolución	Cambie el designador de los pines infractores según corresponda, de modo que cada uno tenga una asignación única. En el editor de componentes, en el modo de edición de un solo componente, haga clic en el control situado en la parte superior derecha de la vista previa del símbolo. En el editor de componentes, en el modo de edición de componentes por lotes, haga clic con el botón derecho en la entrada del símbolo en la región Model Links y seleccione el comando Edit en el menú contextual. El modelo de símbolo que el componente utiliza actualmente (al que hace referencia) se abrirá en el editor temporal de bibliotecas de esquemas. Seleccione los pines infractores y cambie los valores de su propiedad Designator en el panel Properties cuando haya un pin seleccionado (más información), o elimine estos pines mediante el atajo de teclado `Delete`.

Missing Default Designator

Summary	This violation occurs when the component's symbol model has no default designator specified.
Default Report Mode
Notification	A notification is displayed in the Messages panel in the following format: `Missing Default Designator`
Recommendation for Resolution	Specify a default designator for the offending symbol model. In the Component editor in Single Component Editing mode, click the control at the top right of symbol's preview. In the Component editor in Batch Component Editing mode, right-click on the symbol entry in the Model Links region and choose the Edit command from the context menu. The symbol model that is currently being used (referenced) by the component will open in the temporary Schematic Library editor. Open the Properties panel when no object is selected in the design space (learn more) and specify the required designator prefix followed by the `?` character in the Designator field (e.g., `C?`). The question marks in designators of components placed on a schematic sheet will be updated with actual numbers during the Design Annotation process.

Missing Pin Designator

Summary	This violation occurs when a pin in the component's symbol model has no designator specified.
Default Report Mode
Notification	A notification is displayed in the Messages panel in the following format: `Missing Pin Designator of the symbol <SymbolRevisionID>` where: `SymbolRevisionID` is the Item-Revision ID of the offending symbol.
Recommendation for Resolution	Specify a designator for each pin in the offending symbol model. In the Component editor in Single Component Editing mode, click the control at the top right of symbol's preview. In the Component editor in Batch Component Editing mode, right-click on the symbol entry in the Model Links region and choose the Edit command from the context menu. The symbol model that is currently being used (referenced) by the component will open in the temporary Schematic Library editor. Select offending pins and specify values of their Designator property in the Properties panel when a pin is selected (learn more), or remove pins using the `Delete` shortcut.

Missing Pin Name

Summary	This violation occurs when a pin in the component's symbol model has no name specified.
Default Report Mode
Notification	A notification is displayed in the Messages panel in the following format: `Missing Pin Name of the symbol <SymbolRevisionID>. Pin Designator "<PinDesignator>".` where: `SymbolRevisionID` is the Item-Revision ID of the offending symbol. `PinDesignator` is the offending pin's Designator.
Recommendation for Resolution	Specify a name for each pin in the offending symbol model. In the Component editor in Single Component Editing mode, click the control at the top right of symbol's preview. In the Component editor in Batch Component Editing mode, right-click on the symbol entry in the Model Links region and choose the Edit command from the context menu. The symbol model that is currently being used (referenced) by the component will open in the temporary Schematic Library editor. Select offending pins and specify values of their Name property in the Properties panel when a pin is selected (learn more), or remove these pins using the `Delete` shortcut.
Note	Only one violation instance will be listed in the Messages panel for each distinct component. A component may well have a symbol with more than one pin with no name defined.

Missing Pins in Sequence

Summary	This violation occurs when missing pins have been detected in the numerical sequence of the offending symbol's pin designator values. For example, if the symbol has pins with designators `1`, `2`, `5`, and there are no pins with designator `3` and `4`.
Default Report Mode
Notification	A notification is displayed in the Messages panel con el siguiente formato: `Missing Pin Designator In Sequence : <PinDesignatorList> [<LowerPinDesignator>..<UpperPinDesignator>]` donde: `PinDesignatorList` es la lista, separada por comas, de los designadores de pines que faltan en la secuencia numérica detectada en el símbolo que presenta la infracción. `LowerPinDesignator` es el valor numérico mínimo de los designadores de pines detectados en el símbolo que presenta la infracción. `UpperPinDesignator` es el valor numérico máximo de los designadores de pines detectados en el símbolo que presenta la infracción.
Recomendación para la resolución	En el modelo del símbolo que presenta la infracción, añada pines con los designadores que faltan en la secuencia o cambie los designadores de pines para que formen una secuencia continua de valores enteros. En el editor de componentes, en el modo de edición de un solo componente, haga clic en el control situado en la esquina superior derecha de la vista previa del símbolo. En el editor de componentes, en el modo de edición de componentes por lotes, haga clic con el botón derecho en la entrada del símbolo en la región Model Links y seleccione el comando Edit en el menú contextual. El modelo del símbolo que el componente utiliza actualmente (al que hace referencia) se abrirá en el editor temporal de bibliotecas de esquemas. Mediante el comando Place » Pin de los menús principales, añada la cantidad necesaria de pines y especifique los valores de su propiedad Designator en el panel Properties al seleccionar un pin (más información), de modo que los designadores de pines del símbolo formen una secuencia continua de valores enteros. También puede editar la propiedad Designator de los pines ya colocados en el símbolo.
Nota	Hay componentes que no utilizan una numeración secuencial de pines; por ejemplo, un BGA con una numeración de pines no secuencial: A1, A3, A5 (y así sucesivamente). En esta situación, se recomienda publicar el componente con esta infracción e indicar el motivo en las notas de publicación. Como alternativa, configure la comprobación Missing Pins in Sequence en la página Data Management – Component Rule Checks del cuadro de diálogo Preferences en .

Versión para imprimir

Localizado por IA

Si encuentra un problema, seleccione el texto/imagen y presioneCtrl + Enterpara enviarnos sus comentarios.

Disponibilidad de funciones

Las funciones disponibles para usted dependen de qué solución de Altium tenga: Altium Develop, Altium Agile Teams, Altium Agile Enterprise o Altium Designer (con suscripción activa).

Si no ve una función documentada en su software actual, contacte con Ventas de Altium para obtener más información.

Documentación heredada

La documentación de Altium Designer ya no está versionada. Si necesita acceder a la documentación de versiones anteriores de Altium Designer, visite la sección Documentación heredada de la página de Otros instaladores.