ハーネス配線図の定義
The individual wired connections within the harness are specified in the harness wiring diagram (*.WirDoc). Add this document to the harness project from the Projects panel by right-clicking on the project entry and then selecting Add New to Project » Harness Wiring Diagram from the context menu (or use the File » New » Harness Wiring Diagram command from the main menus).
Setting Up a Harness Wiring Diagram Document
Options of a harness wiring diagram document can be configured in the Properties panel when no object is selected in the document's design space. The main settings are:
-
In the General region of the panel's General tab – select the measurement units that apply to the document and its graphic elements and set the grids to enable easier placement. Altium Designer offers three grid types: visible grid for navigation, snap grid for placement, and snap distance for aiding the creation of connections.
-
In the Page Options region of the panel's General tab – configure document sheet size and title block or select from available harness wiring document templates.
The General and Parameters tabs of the Properties panel when no object is selected in the harness wiring diagram document
Synchronizing Multi-board and Harness Projects
When the harness project is part of a multi-board design project, the harness wiring diagram can be synchronized from the multi-board schematic document (*.MbsDoc) data. To do so, select the Design » Import Changes From <Multi-board Project> command from the main menus.
To learn more about adding a harness design project to a multi-board project, refer to the Harness Design page.
If the multi-board schematic document contains more than one harness connection definition, the Select Harness Definition dialog will open. Specify the definition that relates to the current harness project.
The Select Harness Definition dialog
The Engineering Change Order dialog will then open showing the harness connector components and harness nets that were defined in the multi-board schematic, which will form the basis for the harness wiring diagram.
Use the Engineering Change Order dialog to import data from the multi-board project.
After executing the changes (
), the data from the multi-board schematic document is imported into the harness wiring diagram. The connector components, each represented by its schematic symbol, will appear in the harness wiring diagram document, initially in arbitrary positions.
An example of a harness wiring diagram right after import.
Netlines will be shown between the pins to represent the logical connections defined in the multi-board schematic. Note that at this stage, there are no physical wires in the design.
Working with Components
As well as synchronizing from the multi-board schematic document, components can also be placed manually into the harness wiring diagram. This allows components to be placed in a standalone harness project (that is not part of a multi-board project), but also allows additional components to be placed in a harness wiring diagram that is part of a multi-board project.
Use the Components panel to place the symbols of the required components. The component placement process is similar to that in the Schematic editor – refer to the Searching for & Placing Components page to learn more. Note that there will be no net lines for manually added components, as there is no higher-level logical design to drive them.
-
Components are placed from available libraries and represented by their schematic symbol models on a harness wiring diagram. Refer to the Building & Maintaining Your Components and Libraries to learn more about component creation.
-
Multi-part components can also be placed in a harness wiring diagram. When the design data are imported into the harness layout drawing, designators are correctly assigned to the components in the harness layout drawing. If multiple parts of the same component are placed on the harness wiring diagram, only one instance of the component is placed on the harness layout drawing (
).
-
Harness connectors can be used to make connections between multiple multi-board projects that are in a nested configuration.
-
When pasting cut/copied harness components on a harness wiring diagram, designators of pasted components respect the Reset Parts Designators On Paste option from the Schematic – Graphical Editing page of the Preferences dialog. When components are pasted, the numerical part of their designators will reset to
?when the option is enabled.
To move a placed component (or a component being placed from the Components panel) to the desired position, click and hold the left mouse button on it and move the mouse. During dragging, use the Spacebar to rotate the components by 90 degrees and the X and Y keys to flip them horizontally and vertically, respectively.
The harness wiring diagram after moving the components
Properties of a placed component can be configured in the Properties panel when the component is selected in the design space. The Properties panel for a component includes the following tabs:
-
General – general properties of the component, such as designator and comment, location, parameters, etc.
-
Pins – the list of component pins.
-
Cavities – allows socket cavities to be assigned to the component (learn more).
-
Associated Parts – allows additional parts, such as heatshrink, to be assigned to the component.
Tabs of the Properties panel when a component is selected
Assigning Socket Cavities
Socket cavities and their type can be assigned to a harness component. Select a component in the design space to add a cavity and type. Select a pin on the Properties panel's Cavities tab, then click the 
button. Select the desired type from the drop-down. The following cavity types are supported:
-
Crimp – used to provide an electrical connection by compressing a contact barrel around a conductor. For this cavity type, you can specify Strip Length and Pull Off Length values.
-
Seal – used to provide environmental protection by sealing the wire entry point.
-
Plug – used to fill an open (unused) connector cavity to maintain the integrity of the environmental seal.
-
Other – used to specify other/additional parts or materials, e.g., solder.
In the Select Connector dialog that opens, browse to and select the desired cavity. The specific type and pertinent information will be added to the pin on the tab, as shown in the images below, for adding a crimp to pin 1.
For a crimp, seal, or plug, only one cavity of a particular type can be added to a pin. Once a cavity of a particular type has been added, the entry is unavailable (grayed out) in the drop-down. Any number of cavities of the Other type can be added to a pin.
Pins with assigned crimps are denoted by the 
symbol in the design space, as shown in the image below.
The grid region of the Cavities tab supports multi-selection and copy/paste/delete operations for selected entries.
-
Multiple pin entries can be selected using
Click, Hold&Drag,Ctrl+Click,Shift+Click, andCtrl+Ashortcuts. -
When multiple pin entries are selected, click
to add a cavity to all selected pins or click 
or press Deleteto remove added cavities from selected pins. -
To change a pin's cavity, select its entry, then click
to open the Select Connector dialog to select the new cavity.
-
Select one or more pin entries and use
Ctrl+X/Ctrl+Cshortcuts to cut/copy selected entries, then use theCtrl+Vshortcut to paste cut/copied content at the currently selected entry.
Creating Connectivity in the Harness Wiring Diagram
Physical wires are placed in the harness wiring diagram document by selecting the Place » Harness Wire command from the main menus (shortcut: Shift+W).
After selecting the command, click a pin of a connector (a red cross appears at the cursor when it’s over a pin's hotspot) to place the start point of the harness wire. Position the cursor and click to anchor a series of vertex points that define the shape of the harness wire. After placing the final vertex point at another pin's hotspot, right-click to complete placement of the harness wire.
When placing a harness wire, press Shift+Spacebar to cycle through placement modes. The mode specifies how corners are created when placing wires and the angles at which wires can be placed. While in 90 Degree or 45 Degree mode (true orthogonal modes), press Spacebar to cycle between the start and end sub-modes. The current mode and sub-mode are shown in the Status Bar.
When placing a harness wire, the netlines track/refresh 'live,' showing you where to wire in real-time, as demonstrated in the video below. Once a connection is completed, its netline disappears from the document.
Demonstration of the live trace feature
When placed and selected, a harness wire’s vertices can be dragged to change the angle between two adjacent sections (
).
Select a harness wire in the design space to change it in the Properties panel. From the panel, you can rename the selected harness wire, change its width and color, and add parameters that can be shown or hidden in the design space.
The Properties panel when a harness wire is selected
-
A placed harness wire can be replaced with a harness wiring component that includes a single wire. To do this, select the harness wire to be replaced and click the
button at the right of the Design Item ID field in the Properties panel when a wire is selected. In the Replace Component dialog that opens, browse to and select the required component. The placed wire will be updated with the properties and parameters of the selected component while keeping its geometry unchanged. Refer to the Placing a Harness Wiring Component section to learn more.
-
The primary color of a wire is defined by the Color parameter that is presented in a placed harness wire by default. To edit the color, enter its name (e.g.,
Red) or hexadecimal code (by typing in the#character followed by the hexadecimal number, e.g.,#9900FF) as the parameter value. Alternatively, click the color button at the left of the parameter value and use the color selector that opens where the wire color can be specified by RGB or HEX value, by freeform selection, or from a range of presets. -
Multicolored harness wires are supported in the harness wiring diagram by choosing a wire's secondary and tertiary colors. In the Properties panel, click the
drop-down at the bottom of the Parameters region then choose Secondary and Tertiary to define the desired colors; the parameter for the chosen color will appear in the Parameters region. You can also define the border color for the harness wire using the same drop-down then selecting Border. Note that the Color parameter controls the visibility of the combined value of defined wire Color, Secondary Color, and Tertiary Color parameters. Click through the slideshow below for examples.
A wire with only the primary color defined
A wire with the secondary color defined
A wire with the tertiary color defined
A wire with the border color defined
A wire with all color options defined
Multicolored wires are supported by tables in harness design Draftsman documents (
*.HarDwf) – learn more. -
If a harness wire has the
Novalue for its Include Cut parameter, this wire will not be presented in a wiring list and connection table in the manufacturing drawing. -
The Color, Min. Bending Radius, Thickness, and Units parameters of a harness wire are used when synchronizing a harness design project with an MCAD tool using MCAD CoDesigner. Refer to the Synchronizing a Harness Design Project page to learn more.
Adding Splices and Taps
In design situations where a new wire needs to be connected to an already placed wire, a splice (Place » Splice) or tap (Place » Tap) object must be placed first.
-
Splice – the original wire is split into two separate wires by the splice.
Another wire needs to be connected to the selected wire (W4).
A splice placed on the wire. Note that the splice splits the original wire into two in the splice location.
Another wire has been connected to the splice.
When two wires are connected in a T-type fashion, a splice is placed automatically at the location of the T-junction (
).
-
Tap – the original wire remains unbroken.
Another wire needs to be connected to the selected wire (W4).
A tap placed on the wire. Note that the tap does not split the original wire.
Another wire has been connected to the tap.
Properties of a placed splice or tap (its location and visual representation) can be configured in the Properties panel when the object is selected in the design space.
The Properties panel when a splice/tap is selected
The Associated Parts region of the Properties panel allows components to be assigned to the selected splice/tap, and this component will be reflected in the project's BOM.
Adding Cables
To define one or more wires as added to a cable, you can place a cable object on the harness wiring diagram (Place » Harness Cable).
Place a cable to define one or more wires as added to a cable.
When a cable object is selected, the wires covered by this cable are highlighted in the design space in neon green (
).
Properties of a placed cable object (its location, visual representation, and parameters) can be configured in the Properties panel when the object is selected in the design space.
The Properties panel when a cable is selected
Wire Shielding and Twisting
A shield (with or without a connection, such as a drain wire connection) can be attached to a group of wires by placing either a shield (Place » Shield) or a shield with connection (Place » Shield with Connection) object.
In the example shown below, wires W1, W2, and W3 are shielded by a shield without a connection (SH1), and wires W4, W8, and W9 are shielded by a shield with connection (SH2). Wire W10 is placed to connect SH2 to a component pin.
Placed a shield or shield with connection object to denote wires as shielded.
When a shield or shield with connection object is selected, the covered wires are highlighted in neon green in the design space (
).
Properties of a placed shield or shield with connection object (location and visual representation) can be configured in the Properties panel when the object is selected in the design space. The Shield Objects region of the panel lists wires covered by the selected object.
The Properties panel when a shield is selected
-
A shield has a fixed aspect ratio of 2:1 during placement or graphical editing, with the final placement size being determined by the document's current snap grid value. Note that the aspect ratio can be changed manually by editing the shield's Width or Height property, but if the shield is then graphically edited, the aspect ratio will return to the default 2:1.
-
If a shield is associated with wires in multiple places on the harness wiring diagram (i.e. when multiple shield objects with the same designator are placed across different wires), selecting one object will highlight all associated wires in the group, and all these wires will be listed in the Shield Objects region of the Properties panel (
).
Wires can be denoted as twisted together by placing a twist (Place » Twist). A twist can be placed across two or more wires.
In the example shown below, wires W1 and W2 are denoted as twisted together with twist Tw1.
Place a twist object to denote wires as twisted together.
When a twist is selected, the covered wires are highlighted in neon green in the design space (
).
The properties of a placed twist (its location and visual representation) can be configured in the Properties panel when the object is selected in the design space. The Twist Objects region of the panel lists wires covered by the selected twist.
The Properties panel when a twist is selected
-
A twist has a fixed aspect ratio of 1:1 during placement or graphical editing, with the final placement size being determined by the document's current snap grid value. Note that the aspect ratio can be changed manually by editing the twist's Width or Height property, but if the twist is then graphically edited, the aspect ratio will return to the default 1:1.
-
If a twist is associated with wires in multiple places on the harness wiring diagram (i.e. when multiple twist objects with the same designator are placed across different wires), selecting one object will highlight all associated wires in the group, and all these wires will be listed in the Twist Objects region of the Properties panel (
).
-
The Twists per Unit Length and Thickness parameters of a twist are used when synchronizing a harness design project with an MCAD tool using MCAD CoDesigner. Refer to the Synchronizing a Harness Design Project page to learn more.
Unconnected Wires
Unconnected wire ends are indicated with a solid square.
An indicated unconnected wire
A wire end should not be left unconnected. If the design requires an unconnected wire end, a 'no connect' object should be placed at the end (Place » No Connect).
Place a 'no connect' object at the end of a wire that should remain unconnected.
Properties of a placed 'no connect' object (its location and visual representation) can be configured in the Properties panel when the object is selected in the design space.
The Properties panel when a 'no connect' object is selected
Working with Multiple Sheets
A full harness wiring diagram can be defined over multiple sheets (in a 'flat' design fashion, where all sheets exist on the same level), each represented by its own *.WirDoc document. The connectivity is created directly from any sheet to any other sheet using wire break objects (Place » Wire Break) with the same wire designator.
After selecting the wire break placement command, position the object so that its electrical hotspot (the end held by the cursor) touches the wire to which you want to connect, then click or press Enter to effect placement. A placed wire break inherits properties (designator and color) of the wire to which it is connected.
Select a wire break in the design space to change it in the Properties panel. From the panel, you can define the designator of the wire to which it is connected and its style: direction (Left or Right) and color.
-
Note that when changing the color and designator of a wire break, the color and designator of the wire to which the wire break is connected are changed correspondingly, and vice-versa, when changing the color and designator of a wire, the color and designator of the wire break connected to the wire are changed correspondingly.
-
You can also change the properties of a wire break being placed by pressing
Tabafter selecting the placement command. Note that if a designator is defined for the wire break before its placement, the wire to which it is connected will inherit the designator and color of the wire break. -
Wire breaks do not have independent font properties; they use the Document Font properties of the harness wiring diagram document on which they are placed.
-
Wire breaks can also be used to create connectivity within the same harness wiring diagram sheet – for example, instead of placing a wire from one connector pin to another, you can place a short harness wire and wire break on each of these pins (
).
Placing a Harness Wiring Component
When connected to your Workspace, you can create components with predefined structure and properties as required in the connected Workspace and then reuse those components in your harness designs, placing them directly in harness wiring diagram documents.
Refer to the Creating a Harness Wiring Component page to learn more.
These components (each with a defined harness wiring model assigned) are accessed from the Components panel. When the required harness wiring diagram document is the active document in the design space, place a component by right-clicking its entry in the panel and selecting the Place <ComponentName> command from the context menu. The behavior of placing a component differs depending on whether the component includes a single wire object or a cable structure (multiple wires and/or additional objects: cables, shields, etc.).
-
Single wire – when placing a component that includes a single wire object, you will enter harness wire placement mode. The wire being placed will inherit the properties defined during component creation. Refer to the Creating Connectivity in the Harness Wiring Diagram section above to learn more about harness wire placement.
-
Cable structure – when selecting the placement command for a component that includes a cable structure, that cable structure will appear attached to the cursor exactly as it was defined during component creation. Click in the desired place of the harness wiring diagram document to place the component. You can then individually edit objects of the component, for example, to attach wires composing the cable to the pins of harness connectors.
Annotating Harness Objects
Use the commands in the Tools » Annotation menu to annotate the following objects in the harness wiring diagram document:
-
Components
-
Wires
-
Splices and taps
-
Cables
-
Shields and shields with connection
-
Twists
-
'No connect' objects
Annotating objects in a harness wiring diagram document is similar to annotating components in a schematic document (*.SchDoc) of a PCB design project. Use the following links to learn more about annotation commands available for a harness wiring diagram document: