Altium Designer Documentation

Teardrops

Modified by Rob Evans on Jun 19, 2017


The Teardrops dialog is used to add and remove teardrops from the design.

Summary

Teardrops are often added to a routed PCB design to create stronger track-to-pad, track-to-via and track-to-track connections. This is valuable when the the design objects are very small, and is particularly valuable for drilled pads and vias, because mis-alignment between the drill center and the pad/via center can result in the drill hole removing too much of the copper connecting the track to the pad/via. 

Teardrops are created by placing a region object at the required location.

Current teardrop settings are stored as an Altium Designer environment setting on the PC, not in the PCB file.

For more information on the working with teardrops, refer to the Removing Unused Pads and Adding Teardrops page.

Access

To add or remove teardrops to the current PCB, select Tools » Teardrops from the toolbar.

Options/Controls

Teardrops can be added, and their properties defined, as follows:

Working Mode

  • Add/Remove - Add or remove teardrops in accordance with the other dialog settings.

Objects

This setting is used in conjunction with those object types enabled in the Scope region of the dialog.

  • All - Target either all objects, or
  • Selected Only - Only target those objects currently selected in the workspace.

Options

  • Teardrop style: The edge of the region object used to create the teardrop can be straight (Line) or Curved.
    • Curved - Use a Curved Teardrop style.
    • Line -  Use a Line Teardrop style.
  • Force teardrops - If this option is enabled, Teardrops will be applied to all vias and/or SMD pads - even if this results in a DRC violation.
  • Adjust teardrop size - If this option is enabled, the Teardrop size is automatically reduced to meet applicable design rules.
  • Generate report - Create a text report listing both successful and unsuccessful teardrop sites.

Scope

Choose which objects to consider for teardrop addition/removal - ViasSMD PadsTracks, and/or T-Junctions - in conjunction with the coarse-level scoping defined in the Objects region of the dialog. When adding Teardrops, you can configure teardrop sizing as follows:

  • Via/TH Pad - Specify the length and width of the teardrop as percentages of the via/thru-hole pad diameter (d). The defaults are 30% and 70% respectively. Click the blue percentage values to change these as required.
  • SMD Pad (and non-round Thru-Hole Pads) - Specify the length and width of the teardrop as percentages of the attached track width (w). The defaults are 100% and 200% respectively. Click the blue percentage values to change these as required.
  • Tracks - Specify the length of the teardrop as a percentage of the attached track width (w). The default is 100%. Click the blue percentage value to change this as required.
  • T-Junction - Specify the length and width of the teardrop as percentages of the primary track width (w) (the horizontal track in the image). The defaults are 300% and 100% respectively. Click the blue percentage values to change these as required.

Tips

  • Region-based teardrops were introduced in Altium Designer 14.3. In earlier versions teardrops were created from track and arc objects. If required, this style of teardrop can be added or removed by running the Tools » Legacy Tools » Legacy Teardrops command.
Found an issue with this document? Highlight the area, then use Ctrl+Enter to report it.

联系我们

联系原厂或当地办公室

We're sorry to hear the article wasn't helpful to you.
Could you take a moment to tell us why?
You are reporting an issue with the following selected text
and/or image within the active document:
Altium Designer 免费试用
Altium Designer Free Trial
我们开始吧!首先,您或者您的公司已经在使用Altium Designer了吗?

如果您有任何需求,请点击这里联系获取当地办公室销售代表联系方式。.
Copyright © 2019 Altium Limited

既然您在使用Altium Designer,为何仍需要试用?

如果您有任何需求,请点击这里联系获取当地办公室销售代表联系方式。.
Copyright © 2019 Altium Limited

好的,实际上您无需下载一个试用版本。

点击下方按钮下载最新版本的Altium Designer安装包

下载Altium Designer 安装包

如果您有任何需求,请点击这里联系获取当地办公室销售代表联系方式。.
Copyright © 2019 Altium Limited

填写下方表格,获取Altium Designer最新报价。

点击[获取免费试用],并同意我们的隐私政策。您会接收到来自Altium的资讯,并允许其改变您的通知首选项。

如果您是Altium维保期内客户,您不需要下载试用版本。

如果您不是Altium维保客户,请填写下方表格免费试用。

点击[获取免费试用],并同意我们的隐私政策。您会接收到来自Altium的资讯,并允许其改变您的通知首选项。

您为何想要试用Altium Designer?

如果您有任何需求,请点击这里联系获取当地办公室销售代表联系方式。.
Copyright © 2019 Altium Limited

那您来对地方了!请填写下方表格申请试用吧。

点击[获取免费试用],并同意我们的隐私政策。您会接收到来自Altium的资讯,并允许其改变您的通知首选项。

Great News!

Valid students can get their very own 6-month Altium Designer Student License for FREE! Just fill out the form below to request your Student License today.

点击[获取免费试用],并同意我们的隐私政策。您会接收到来自Altium的资讯,并允许其改变您的通知首选项。

好的,您可以下载免费的Altium Designer Viewer查看文档,有效期6个月。

请填写下方表格申请。

点击[获取免费试用],并同意我们的隐私政策。您会接收到来自Altium的资讯,并允许其改变您的通知首选项。

好棒!创作是一件超酷的事情,我们可以为您提供完美的设计软件。

Upverter是一个社区导向的交流平台,专为您这样的创客量身定做。

点击这里看看吧!

如果您有任何需求,请点击这里联系获取当地办公室销售代表联系方式。.
Copyright © 2019 Altium Limited

好的,您可以下载免费的Altium Designer Viewer查看文档,有效期6个月。

请填写下方表格申请。

点击[获取免费试用],并同意我们的隐私政策。您会接收到来自Altium的资讯,并允许其改变您的通知首选项。